Simulation of Free Surface Flows with Surface Tension with ANSYS CFX
|
|
- Howard Cain
- 6 years ago
- Views:
Transcription
1 Simulation of Free Surface Flows with Surface Tension with ANSYS CFX C. Kurt Svihla, Hong Xu ANSYS, Inc. Abstract Three different test cases involving free surface flows with surface tension were investigated with ANSYS CFX. Transient analyses were performed in all cases. The three cases were: (1) oscillations of a twodimensional cylindrical rod; (2) rise of liquid in a capillary; and (3) rise of an air bubble train through stagnant water. The mesh resolution, timestep, and solver settings required to obtain accurate results for the individual cases were investigated and are reported for the individual cases. Good agreement between the simulation results and results reported in the literature were obtained for the cases studied. Introduction Typically multifluid free surface flows exhibit a distinct, sharp interface between the phases. The position of this interface is normally of great interest and a number of methods have been developed to resolve and track this interface in computationa fluid dynamics (CFD) simulations of free surface problems. Annaland et al. (2005) recently reviewed a number of different methods for simulating multifluid flows with sharp interfaces listing advantages and disadvantages of each. The various methods they discuss include level set, shock-capturing, marker particle, simple line interface calculation volume-of-fluid (SLIC VOF), piecewise line interface calculation volume-of-fluid (PLIC VOF), Lattice Boltzmann, and front-tracking approaches. The goal of the different approaches is to track the position of the interface accurately without introducing excessive computational smearing. When the interface between the fluids is highly curved, then the effect of the surface tension force in the multifluid simulation becomes particularly important. Surface tension acts at the interface between two fluids. Computationally, this is awkward to deal with and the role of surface tension is generally incorporated as a continuum surface force using the approach of Brackbill et al. (1992). ANSYS CFX uses a compressive discretization scheme in both time and space to minimize the smearing of the free surface at the interface. Typically, this reduces smearing at the interface to two or three layers of cells. This is an interface capturing approach rather than an interface reconstruction approach of the type reviewed by Annaland et al.. Three different test cases for modeling transient free surface flows with surface tension have been considered. These include the oscillation of a planar rod initially deformed from a circular cross-section, rise of fluid in a capillary, and rise of a spherical air bubble train through otherwise stagnant liquid water. Procedure Oscillation of a Planar 2D Rod For this simulation, a planar 2D geometry was constructed. The initial condition for the simulation had the liquid confined to a square region. The transient simulation then modeled the oscillation of the droplet as it approached a circular cross-section.
2 The computational domain was 4 cm x 4 cm (planar 2D) with a thickness of 0.1 cm in the symmetry direction. The homogeneous free surface model in ANSYS CFX was used to simulate the oscillation of the rod or droplet. Buoyancy was neglected in the analysis. The interface compression level was set to 2. According to Ham and Young, (2003), the expected angular frequency of oscillation for a 2D column in the inviscid limit should be given by the expression of Lamb (1932): ω 2 = (n)(n 2-1) (γ/ρ r 3 ) where n is the mode of oscillation. Dynamic Capillary Rise For the capillary rise simulation, the experimental apparatus used by Zhmud et al. (2000) was simulated. In their paper, Zhmud et al. reported dynamic capillary rise measurements for dodecane rising through a precision bore borosilicate glass capillary. An axisymmetric 2D mesh was constructed for the simulation. The computational domain comprised an angular extent of 5 degrees. The initial condition had a flat interface between gas and liquid with the capillary extending a short distance into the liquid. The inner surface of the capillary wall had a contact angle of 17 prescribed so that liquid would rise inside it as the transient simulation proceeded. No wall adhesion parameters were defined for any of the other walls in the geometry. The homogeneous free surface model in ANSYS CFX was used to simulate the transient rise of liquid in the capillary. Buoyancy was included in the analysis with a reference density equal to that of the gas phase. In the surface tension model, the volume fraction smoothing type was set to none which proved to be important in maintaining a reasonably well-resolved curved interface. The interface compression level was set to 2. Rise of a Bubble Train through a Stagnant Liquid This simulation considered rise of a 1 mm diameter air bubble train through otherwise stagnant water. Periodic conditions were imposed at the upper and lower bounds of the domain so that rise of a train of bubbles rather than a single isolated bubble was considered. An axisymmetric 2D mesh was constructed for the simulation. The computational domain comprised an angular extent of 5 degrees. The initial condition for the simulation placed a bubble with a diameter of 1mm near the lower bound of the domain. A chart given by Grace and Weber (1982) shows that a 1 mm air bubble should remain spherical as it rises so that an axisymmetric treatment is appropriate. Bubbles much larger than this would follow helical paths as they rise which an axisymmetric treatment would not fully capture. The same chart by Grace and Weber (1982) shows that the expected terminal velocity of a 1mm diameter air bubble rising through pure water is approximately 18.1 cm/s. The homogeneous free surface model in ANSYS CFX was used to simulate the transient rise of the bubble through the liquid. Buoyancy was included in the analysis with a reference density equal to that of the liquid phase. In the surface tension model, the volume fraction smoothing type was set to none and the curvature underrelaxation factor was set to 0.5. The interface compression level was set to 2.
3 Analysis Oscillation of a Planar 2D Rod The simulation was run in double precision with a timestep of s and a maximum of 30 coefficient loops per time step. The grid consisted entirely of prisms (extruded triangles). The grid was one layer thick in the symmetry direction with a thickness of 0.04 cm in that direction. A cross-sectional view is shown in Figure 1. The grid consisted of 25,262 wedge or prism elements. Figure 1. Cross-Section of the Computational Grid for the Oscillating Rod Simulation The fluid properties used were characteristic of an oil-air two phase system with a liquid density of 790 kg/m3 and a gas density of 1.2 kg/m3. The surface tension for this system was set to N/m. The dynamic viscosity of the gas and liquid phases were both set to Pa s. Flow was assumed to be laminar. The initial condition for the transient simulation consisted of zero velocity and pressure with a 2 cm x 2 cm square initialized to contain liquid.
4 Based on the initial volume of the liquid the final radius of the circular rod should be cm and the equilibrium pressure inside the cylindrical rod should be γ/r or 2.09 Pa. The mode of oscillation for an initial square is four so that the expected period of oscillation for the system under the imposed conditions works out to s. Dynamic Capillary Rise For the dodecane-air system simulated for this analysis, the interfacial tension was N/m and the contact angle was 17. The liquid density was 750 kg/m3, the liquid viscosity was Pa s, and the radius of the capillary was 0.10 mm. The axisymmetric mesh was constructed for simulation had an angular extent of 5 degrees and inner and outer radii of 0 mm and 5.1 mm, respectively. The length of the computational domain in the axial direction was 25 mm. The mesh consisted of hexahedral elements with 697 wedges or prisms located along the axis of the geometry. The capillary was resolved by 10 uniformly spaced cells in the radial direction. Laminar flow in both phases was assumed for the simulation. The initial condition for the simulation consisted of stationary gas and liquid phases with the interface located so as to give an initial liquid depth of 20 mm. The initial pressure was defined so as to include the hydrostatic pressure in the liquid phase. The capillary extended a short distance into the liquid phase as shown in Figure 2. Figure 2. Initial Condition for the Capillary Rise Simulation The simulation was run in double precision with a timestep of 2e-5 s and a maximum of 20 coefficient loops per timestep.
5 Rise of a Bubble Train through a Stagnant Liquid For the air-water system simulated for this analysis, the interfacial tension was N/m. The liquid density was 997 kg/m 3 and the liquid viscosity was Pa s, and the radius of the capillary was 0.10 mm. The air density was set to kg/m 3 and the air viscosity to Pa s. For a bubble with a diameter of 1 mm and with a surface tension of N/m, the expected pressure inside the bubble is 2γ/R or 288 Pa The axisymmetric mesh constructed for the simulation had an angular extent of 5 degrees with radial and axial dimensions of 5 mm and 20 mm, respectively. The radius of the 1 mm diameter bubble was resolved by approximately 10 cells. Overall, there were 55 cells in the radial direction and 400 cells in the axial direction for a total of elements in the computational mesh (21600 hexahedral elements and 400 wedge elements along the axis). A partial view of the computational mesh is shown in Figure 3 which shows the initial condition for volume fraction for the simulation at one of the symmetry planes for the whole radius and the lower half of the domain. This mesh was the same used by Xu and Guetari (2004a) for a similar analysis in CFX-4. Figure 3. Initial Condition for the Bubble Rise Simulation Flow was assumed to be laminar in both phases. A variable time step was used ranging from 1e-6 s at the start of the simulation to 4e-5 s at later stages. A maximum of 30 coefficient loops per timestep were used with a conservation target of 0.01 and a residual criterion of 1e-6. The initial condition for the simulation consisted of stationary gas and liquid phases with a uniform zero initial relative pressure with volume fractions set so as to define a 1 mm bubble near the bottom of the domain.
6 Analysis Results & Discussion Oscillation of a Planar 2D Rod Figures 4 through 8 show the oscillation in the shape of the liquid at various times during the simulation. Figure 4. Initial Shape of the Liquid Droplet Figure 5. Shape of the Liquid Droplet at 0.01 s
7 Figure 6. Shape of the Liquid Droplet at 0.05 s Figure 7. Shape of the Liquid Droplet at 0.09 s
8 Figure 8. Shape of the Liquid Droplet at 0.13 s Figure 9 shows the oscillation in the maximum height of the isosurface over the computation period of 1.1 s. The computed period of oscillation is 0.18 s which matches the expected period of s very closely. There is about a 20% reduction in the amplitude of the oscillation from one period to the next. The droplet radius in the simulation is approaching the expected final value of cm. Figure 9. Oscillation of the Maximum Height of the Droplet
9 The average pressure inside the droplet has attained a stable value of approximately 2.18 Pa after 1.1 s of simulation time which compares favorably with the expected equilibrium value of 2.09 Pa. Figure 10 shows the oscillation of the average pressure within the rod over time. The period for the pressure oscillation appears to be approximately one-half of that for the oscillation in droplet shape. Figures 11 through 15 show pressure fluctuations within the droplet at different stages of the simulation. Figure 10. Oscillation of the Average Pressure within the Droplet Figure 11. Pressure Contours at 0.49 s for the Oscillating Rod
10 Figure 12. Pressure Contours at 0.51 s for the Oscillating Rod Figure 13. Pressure Contours at 0.67 s for the Oscillating Rod
11 Figure 14. Pressure Contours at 0.75 s for the Oscillating Rod Figure 15. Pressure Contours at 0.79 s for the Oscillating Rod The droplet did remain centered within the computational domain and symmetry in the z-direction was maintained throughout the simulation.
12 Dynamic Capillary Rise Figures 16 and 17 show the capillary rise after 0.06 s of simulation time (Figure 17 shows the computational grid in order to display the mesh resolution). The contact angle enforced on the inner wall of the capillary is causing curvature of the interface and a meniscus to develop. It is worth noting that the liquid interface away from the immediate vicinity of the capillary tube does remain flat throughout the simulation as is displayed in Figures 16 and 17. Figure 16. Capillary Rise at a Simulation Time of 0.06 s Figure 17. Capillary Rise at a Simulation Time of 0.06 s (with superimposed grid)
13 Figure 18 shows a comparison of the transient capillary rise predicted by this simulation with the experimental data reported by Zhmud et al. (2000) and earlier results for this same system obtained by Xu and Guetari (2004b) with the CFX-4 code. The agreement between experiment and simulation is fairly good with the present results obtained with ANSYS CFX 10 matching experimental trends for longer simulation times than the earlier results obtained with CFX-4. Figure 18. Comparison of Experimental and Simulated Transient Capillary Rise Rise of a Bubble Train through a Stagnant Liquid As the simulation proceeds, the bubble initially remains spherical with a relatively crisp interface around the bubble perimeter. Although a zero initial pressure was set for the simulation, the pressure inside the bubble develops according to the expected value of 288 Pa. Figure 19 shows the position of the bubble after approximately s of simulation time. The pressure inside the bubble is already near the expected value. The interface is relative crisp around the bubble perimeter. At this stage, the bubble position has been deflected only slightly from its initial position.
14 Figure 19. Bubble Pressure and Position after s of Simulation Time As the bubble begins to rise, there is some smearing of the interface at the tail of the bubble although the interface remains crisp at the bubble s leading edge. If an isosurface for an air volume fraction of 0.5 is used to define the extent of the bubble, then the bubble remains approximately spherical as it begins to rise. Figures 20 and 21 show plots of volume fraction and pressure on one of the symmetry planes after 0.01 s of rise time. At this stage, the bubble has moved upward approximately 1 bubble diameter. The interface at the bubble tail has been smeared over three or four layers of cells. The pressure inside the bubble has been reduced slightly but is still close to the expected value.
15 Figure 20. Bubble Volume Fraction and Position after 0.01 s of Simulation Time Figure 21. Bubble Pressure and Position after 0.01 s of Simulation Time
16 Figure 22 shows a plot of volume fraction on one of the symmetry planes after 0.02 s of rise time. At this stage, the bubble has moved upward approximately 3.5 bubble diameters. There has been some smearing and a slight loss of material in the bubble wake. Calculations of the volume enclosed by an isosurface defined by an air volume fraction of 0.5 indicate that about 8% of the original bubble volume has been lost which corresponds to a diameter reduction of about 3%. This calculation is somewhat imprecise since the grid resolution for the bubble is fairly coarse and the circular bounds of the isovolume are approximated by a Cartesian grid. Nevertheless, both the crispness of the interface and preservation of the initial bubble size could be improved by increasing the resolution of the grid. Dijkhuizen et al. (2005) note that it has proven to be particularly difficult to simulate the motion of small bubbles with diameters on the order of 1 mm with VOF or front-tracking approaches due to parasitic currents and unacceptable loss of material due to the surface tension treatment. Viewed in this light, the current results seems encouraging especially since Dijkhuizen et al. state that their front-tracking simulations were the first published results for 1 mm bubbles with realistic fluid properties. Figure 22. Bubble Volume Fraction and Position after 0.02 s of Simulation Time Figure 23 shows a plot of the bubble s upward velocity with time. After 0.02 s, the rise velocity is in reasonably good agreement with the expected terminal rise velocity and is trending towards a stable value. The spherical bubble shape has been maintained during this simulation period. Care should be taken to examine long-term results to ensure that the bubble size remains within acceptable limits as it rises.
17 Figure 23. Transient Bubble Rise Velocity Conclusion In this paper, three cases of simulating free surface flows with surface tension with ANSYS CFX have been presented. Whenever possible, the results from ANSYS CFX were verified by comparison with experimental data, correlations, or theory. For the three cases considered, the results from ANSYS CFX are generally in good agreement with the expected values and behavior. References Annaland, M. van Sint, W. Dijkhuizen, N.G. Deen, and J.A.M Kuipers, 2006, Numerical Simulation of Gas Bubbles using a 3-D Front-Tracking Method, AIChe J., Brackbill, J.U., D.B. Kothe, and C. Zemach, 1992, A Continuum Method for Modeling Surface Tension, Journal of Computational Physics, 110, Dijkhuizen, W., E.I.V. van den Hengel, N.G. Deen, M. van Sint Annaland and J.A.M. Kuipers, 2005, Numerical Investigation of Closures for Interface Forces Acting on Single Air-Bubbles in Water Using Volume of Fluid and Front Tracking Models, Chem. Eng. Sci., 60, , Ham, F., and Y.N. Young, 2003, A Cartesian Adaptive Level Set Method for Two-Phase Flows, Center for Turbulence Research Annual Research Briefs, Lamb, H., 1932, Hydrodynamics, Cambridge University Press. Xu, H. and C. Guetari, 2004a, Numerical Simulations of a Train of Air Bubbles Rising Through Stagnant Water, 2004 International ANSYS Conference, Pittsburgh.
18 Xu, H. and C. Guetari, 2004b, The Use of CFD to Simulate Capillary Rise and Comparison to Experimental Data, 2004 International ANSYS Conference, Pittsburgh. Zhmud, B.V., F. Tiberg, and K. Hallstensson, 2000, Dynamics of Capillary Rise, J. Colloid and Interface Science, 228,
Numerical Simulations of a Train of Air Bubbles Rising Through Stagnant Water
Numerical Simulations of a Train of Air Bubbles Rising Through Stagnant Water Hong Xu, Chokri Guetari ANSYS INC. Abstract Transient numerical simulations of the rise of a train of gas bubbles in a liquid
More informationWorkshop 1: Bubbly Flow in a Rectangular Bubble Column. Multiphase Flow Modeling In ANSYS CFX Release ANSYS, Inc. WS1-1 Release 14.
Workshop 1: Bubbly Flow in a Rectangular Bubble Column 14. 5 Release Multiphase Flow Modeling In ANSYS CFX 2013 ANSYS, Inc. WS1-1 Release 14.5 Introduction This workshop models the dispersion of air bubbles
More informationVapour pressure of liquids SURFACE TENSION
Vapour pressure of liquids A liquid in a closed container is subjected to partial vapour pressure due to the escaping molecules from the surface; it reaches a stage of equilibrium when this pressure reaches
More informationZIN Technologies PHi Engineering Support. PHi-RPT CFD Analysis of Large Bubble Mixing. June 26, 2006
ZIN Technologies PHi Engineering Support PHi-RPT-0002 CFD Analysis of Large Bubble Mixing Proprietary ZIN Technologies, Inc. For nearly five decades, ZIN Technologies has provided integrated products and
More informationCFD Simulation and Experimental Validation of a Diaphragm Pressure Wave Generator
CFD Simulation and Experimental Validation of a Diaphragm Pressure Wave Generator T. Huang 1, A. Caughley 2, R. Young 2 and V. Chamritski 1 1 HTS-110 Ltd Lower Hutt, New Zealand 2 Industrial Research Ltd
More informationInfluence of rounding corners on unsteady flow and heat transfer around a square cylinder
Influence of rounding corners on unsteady flow and heat transfer around a square cylinder S. K. Singh Deptt. of Mech. Engg., M. B. M. Engg. College / J. N. V. University, Jodhpur, Rajasthan, India Abstract
More informationIrrigation &Hydraulics Department lb / ft to kg/lit.
CAIRO UNIVERSITY FLUID MECHANICS Faculty of Engineering nd Year CIVIL ENG. Irrigation &Hydraulics Department 010-011 1. FLUID PROPERTIES 1. Identify the dimensions and units for the following engineering
More informationON THE EFFECT OF LIFT FORCES IN BUBBLE PLUMES
Ninth International Conference on CFD in the Minerals and Process Industries CSIRO, Melbourne, Australia 10-12 December 2012 ON THE EFFECT OF LIFT FORCES IN BUBBLE PLUMES Jan Erik OLSEN* and Mihaela POPESCU
More informationNumerical simulation of an intermediate sized bubble rising in a vertical pipe
Computational Methods in Multiphase Flow V 111 Numerical simulation of an intermediate sized bubble rising in a vertical pipe J. Hua 1, S. Quan 2 & J. Nossen 1 1 Department of Process and Fluid Flow Technology,
More informationEffect of Inlet Clearance Gap on the Performance of an Industrial Centrifugal Blower with Parallel Wall Volute
International Journal of Fluid Machinery and Systems DOI: http://dx.doi.org/10.5293/ijfms.2013.6.3.113 Vol. 6, No. 3, July-September 2013 ISSN (Online): 1882-9554 Original Paper (Invited) Effect of Inlet
More informationAir Bubble Defects in Dispensing Nanoimprint Lithography
Air Bubble Defects in Dispensing Nanoimprint Lithography Abstract We report a theoretical study and dynamic simulation to understand the dynamic behavior of the air bubble defects in Dispensing Nanoimprint
More informationInvestigation on Divergent Exit Curvature Effect on Nozzle Pressure Ratio of Supersonic Convergent Divergent Nozzle
RESEARCH ARTICLE OPEN ACCESS Investigation on Divergent Exit Curvature Effect on Nozzle Pressure Ratio of Supersonic Convergent Divergent Nozzle Shyamshankar.M.B*, Sankar.V** *(Department of Aeronautical
More informationInjector Dynamics Assumptions and their Impact on Predicting Cavitation and Performance
Injector Dynamics Assumptions and their Impact on Predicting Cavitation and Performance Frank Husmeier, Cummins Fuel Systems Presented by Laz Foley, ANSYS Outline Overview Computational Domain and Boundary
More information! =! [4 (2) ! n] 16 th Australasian Fluid Mechanics Conference Crown Plaza, Gold Coast, Australia 2-7 December 2007
16 th Australasian Fluid Mechanics Conference Crown Plaza, Gold Coast, Australia 2-7 December 2007 Liquid Film Falling on Horizontal Circular Cylinders F. Jafar, G. Thorpe and O.F. Turan School of Architectural,
More informationNumerical Investigation of Air Bubbles Evolution and Coalescence from Submerged Orifices Based on OpenFOAM
Numerical Investigation of Air Bubbles Evolution and Coalescence from Submerged Orifices Based on OpenFOAM Pan Feng, He Ying, Li-zhong Mu 2018-7-6 Dalian University of Technology, China Outline Background
More informationComputational Analysis of Oil Spill in Shallow Water due to Wave and Tidal Motion Madhu Agrawal Durai Dakshinamoorthy
Computational Analysis of Oil Spill in Shallow Water due to Wave and Tidal Motion Madhu Agrawal Durai Dakshinamoorthy 1 OUTLINE Overview of Oil Spill & its Impact Technical Challenges for Modeling Review
More informationAnalyzing a Malfunctioning Clarifier with COMSOL s Mixture Model
Excerpt from the Proceedings of the COMSOL Conference 2008 Hannover Analyzing a Malfunctioning Clarifier with COMSOL s Mixture Model Arie C. de Niet,1, Arjen F. van Nieuwenhuijzen 1, and Arthur J. Geilvoet
More informationSimulation of Gas Holdup in a Bubble Column with a Draft Tube for Gas Dispersion into an Annulus
Simulation of Gas Holdup in a Bubble Column with a Draft Tube for Gas Dispersion into an Annulus Fukuji Yamashita Dept. of Applied Bioscience, Kanagawa Institute of Technology, Atsugi 243-292, Japan, yamasita@bio.kanagawa-it.ac.jp
More informationExperimental study on path instability of rising bubbles
Experimental study on path instability of rising bubbles V. MOTURI, D. FUNFSCHILLING, J. DUSEK ICube, UMR 7357 Mécanique des fluids,2 rue Boussingault,67000,Strasbourg,France. viswa-maitreyi.moturi@etu.unistra.fr
More informationChapter 3 PRESSURE AND FLUID STATICS
Fluid Mechanics: Fundamentals and Applications, 2nd Edition Yunus A. Cengel, John M. Cimbala McGraw-Hill, 2010 Chapter 3 PRESSURE AND FLUID STATICS Lecture slides by Hasan Hacışevki Copyright The McGraw-Hill
More information. In an elevator accelerating upward (A) both the elevator accelerating upward (B) the first is equations are valid
IIT JEE Achiever 2014 Ist Year Physics-2: Worksheet-1 Date: 2014-06-26 Hydrostatics 1. A liquid can easily change its shape but a solid cannot because (A) the density of a liquid is smaller than that of
More informationANALYSIS OF AERODYNAMIC CHARACTERISTICS OF A SUPERCRITICAL AIRFOIL FOR LOW SPEED AIRCRAFT
ANALYSIS OF AERODYNAMIC CHARACTERISTICS OF A SUPERCRITICAL AIRFOIL FOR LOW SPEED AIRCRAFT P.Sethunathan 1, M.Niventhran 2, V.Siva 2, R.Sadhan Kumar 2 1 Asst.Professor, Department of Aeronautical Engineering,
More informationNumerical Simulations of Bubbling Fluidized Beds
Numerical Simulations of Bubbling Fluidized Beds A. Busciglio, G. Micale, L.Rizzuti, G. Vella. Università degli Studi di Palermo Dipartimento di Ingegneria Chimica dei Processi e dei Materiali Viale delle
More informationCFD Simulations for Continuous Flow of Bubbles through Gas-Liquid Columns: Application of VOF Method.
Curtin University of Technology From the SelectedWorks of Abid Akhtar Mr March, 2007 CFD Simulations for Continuous Flow of Bubbles through Gas-Liquid Columns: Application of VOF Method. Abid Akhtar Available
More informationThe Usage of Propeller Tunnels For Higher Efficiency and Lower Vibration. M. Burak Şamşul
The Usage of Propeller Tunnels For Higher Efficiency and Lower Vibration M. Burak Şamşul ITU AYOC 2014 - Milper Pervane Teknolojileri Company Profile MILPER is established in 2011 as a Research and Development
More informationWind tunnel effects on wingtip vortices
48th AIAA Aerospace Sciences Meeting Including the New Horizons Forum and Aerospace Exposition 4-7 January 2010, Orlando, Florida AIAA 2010-325 Wind tunnel effects on wingtip vortices Xin Huang 1, Hirofumi
More informationAir Bubble Departure on a Superhydrophobic Surface
Air Bubble Departure on a Superhydrophobic Surface A. Kibar 1, R. Ozbay 2, C.H. Choi 2 1 Department of Mechanical and Material Technologies, Kocaeli University, 41285, Kocaeli, Turkey 2 Department of Mechanical
More informationThe Mechanism Study of Vortex Tools Drainage Gas Recovery of Gas Well
Advances in Petroleum Exploration and Development Vol. 7, No. 1, 214, pp. 62-66 DOI:1.3968/j.aped.1925543821471.1931 ISSN 1925-542X [Print] ISSN 1925-5438 [Online] www.cscanada.net www.cscanada.org The
More informationDetermination of the wind pressure distribution on the facade of the triangularly shaped high-rise building structure
Determination of the wind pressure distribution on the facade of the triangularly shaped high-rise building structure Norbert Jendzelovsky 1,*, Roland Antal 1 and Lenka Konecna 1 1 STU in Bratislava, Faculty
More informationEffect of Argon Gas Distribution on Fluid Flow in the Mold Using Time-Averaged k-ε Models
Effect of Argon Gas Distribution on Fluid Flow in the Mold Using Time-Averaged k-ε Models B. G. Thomas, T. Shi and L. Zhang Department of Materials Science &. Engineering University of Illinois at Urbana-Champaign
More informationFree Surface Flow Simulation with ACUSIM in the Water Industry
Free Surface Flow Simulation with ACUSIM in the Water Industry Tuan Ta Research Scientist, Innovation, Thames Water Kempton Water Treatment Works, Innovation, Feltham Hill Road, Hanworth, TW13 6XH, UK.
More informationAIRFLOW GENERATION IN A TUNNEL USING A SACCARDO VENTILATION SYSTEM AGAINST THE BUOYANCY EFFECT PRODUCED BY A FIRE
- 247 - AIRFLOW GENERATION IN A TUNNEL USING A SACCARDO VENTILATION SYSTEM AGAINST THE BUOYANCY EFFECT PRODUCED BY A FIRE J D Castro a, C W Pope a and R D Matthews b a Mott MacDonald Ltd, St Anne House,
More informationDevelopment of Technology to Estimate the Flow Field around Ship Hull Considering Wave Making and Propeller Rotating Effects
Development of Technology to Estimate the Flow Field around Ship Hull Considering Wave Making and Propeller Rotating Effects 53 MAKOTO KAWABUCHI *1 MASAYA KUBOTA *1 SATORU ISHIKAWA *2 As can be seen from
More informationAERODYNAMIC CHARACTERISTICS OF NACA 0012 AIRFOIL SECTION AT DIFFERENT ANGLES OF ATTACK
AERODYNAMIC CHARACTERISTICS OF NACA 0012 AIRFOIL SECTION AT DIFFERENT ANGLES OF ATTACK SUPREETH NARASIMHAMURTHY GRADUATE STUDENT 1327291 Table of Contents 1) Introduction...1 2) Methodology.3 3) Results...5
More informationA Numerical Simulation Comparing the Efficiencies of Tubercle Versus Straight Leading Edge Airfoils for a Darrieus Vertical Axis Wind Turbine
A Numerical Simulation Comparing the Efficiencies of Tubercle Versus Straight Leading Edge Airfoils for a Darrieus Vertical Axis Wind Turbine By: Ross Neal Abstract: The efficiencies of sinusoidal and
More informationMODELLING OF BUBBLE FORMATION WITHTHEAIDOFCFD
TASKQUARTERLY8No1(2004),17 26 MODELLING OF BUBBLE FORMATION WITHTHEAIDOFCFD ANDRZEJK.BIŃ,PIOTRM.MACHNIEWSKI 1 AND LESZEK RUDNIAK Department of Chemical and Process Engineering, Warsaw University of Technology,
More informationComputer Simulation Helps Improve Vertical Column Induced Gas Flotation (IGF) System
JOURNAL ARTICLES BY FLUENT SOFTWARE USERS JA187 Computer Simulation Helps Improve Vertical Column Induced Gas Flotation (IGF) System Computer simulation has helped NATCO engineers make dramatic improvements
More informationTwo interconnected rubber balloons as a demonstration showing the effect of surface tension
Two interconnected rubber balloons as a demonstration showing the effect of surface tension Abstract Science One 28-9 CHEN, Chieh-Shan The two interconnected rubber balloons system is a demonstration widely
More informationPhysics 221, March 1. Key Concepts: Density and pressure Buoyancy Pumps and siphons Surface tension
Physics 221, March 1 Key Concepts: Density and pressure Buoyancy Pumps and siphons Surface tension Fluids: Liquids Incompressible Gases Compressible Definitions Particle density: Density: Pressure: ρ particle
More informationA Computational Assessment of Gas Jets in a Bubbly Co-Flow 1
A Computational Assessment of Gas Jets in a Bubbly Co-Flow 1 Melissa Fronzeo*, 1 Michael Kinzel 1 The Pennsylvania State University, University Park, PA, USA Abstract In this effort, Computational Fluid
More informationEvaluation of Cavitation in Hydraulic Turbomachinery Using STAR-CCM+
Evaluation of Cavitation in Hydraulic Turbomachinery Using STAR-CCM+ Dr. Edward M. Bennett Vice President of Fluids Engineering Mechanical Solutions, Inc. Whippany, NJ07981 USA emb@mechsol.com 7 March,
More informationFlow and Mixing in the Liquid between Bubbles
Excerpt from the Proceedings of the COMSOL Conference 2009 Boston Flow and Mixing in the Liquid between Bubbles Bruce A. Finlayson, Professor Emeritus of Chemical Engineering Department of Chemical Engineering,
More informationWind Flow Model of Area Surrounding the Case Western Reserve University Wind Turbine
Wind Flow Model of Area Surrounding the Case Western Reserve University Wind Turbine Matheus C. Fernandes 1, David H. Matthiesen PhD *2 1 Case Western Reserve University Dept. of Mechanical Engineering,
More informationTHE COALESCENCE OF BUBBLES - A NUMERICAL STUDY
Third International Conference on Multiphase Flow, ICMF 98 Lyon, France, June 8-, 998 THE COALESCENCE OF BUBBLES - A NUMERICAL STUDY Li Chen, Yuguo Li and Richard Manasseh Advanced Fluid Dynamics Laboratory
More informationA Numerical Prediction of the Hydrodynamic Torque acting on a Safety Butterfly Valve in a Hydro-Electric Power Scheme
A Numerical Prediction of the Hydrodynamic Torque acting on a Safety Butterfly Valve in a Hydro-Electric Power Scheme School of Engineering University of Tasmania Hobart AUSTRALIA alan.henderson@utas.edu.au
More informationCFD Analysis and Experimental Study on Impeller of Centrifugal Pump Alpeshkumar R Patel 1 Neeraj Dubey 2
IJSRD - International Journal for Scientific Research & Development Vol. 3, Issue 2, 21 ISSN (online): 2321-613 Alpeshkumar R Patel 1 Neeraj Dubey 2 1 PG Student 2 Associate Professor 1,2 Department of
More informationEXPERIMENTAL STUDY ON THE HYDRODYNAMIC BEHAVIORS OF TWO CONCENTRIC CYLINDERS
EXPERIMENTAL STUDY ON THE HYDRODYNAMIC BEHAVIORS OF TWO CONCENTRIC CYLINDERS *Jeong-Rok Kim 1), Hyeok-Jun Koh ), Won-Sun Ruy 3) and Il-Hyoung Cho ) 1), 3), ) Department of Ocean System Engineering, Jeju
More informationCFD SIMULATIONS OF GAS DISPERSION IN VENTILATED ROOMS
CFD SIMULATIONS OF GAS DISPERSION IN VENTILATED ROOMS T. Gélain, C. Prévost Institut de Radioprotection et de Sûreté Nucléaire (IRSN), Saclay, France Abstract In order to better understand the risks due
More informationTHEORETICAL EVALUATION OF FLOW THROUGH CENTRIFUGAL COMPRESSOR STAGE
THEORETICAL EVALUATION OF FLOW THROUGH CENTRIFUGAL COMPRESSOR STAGE S.Ramamurthy 1, R.Rajendran 1, R. S. Dileep Kumar 2 1 Scientist, Propulsion Division, National Aerospace Laboratories, Bangalore-560017,ramamurthy_srm@yahoo.com
More informationApplication of CFD for Improved Vertical Column Induced Gas Flotation (IGF) System Development
Application of CFD for Improved Vertical Column Induced Gas Flotation (IGF) System Development Chang-Ming Lee and Ted Frankiewicz NATCO Group, Inc., 2950 North Loop West, Suite 750, Houston, TX 77092 Prepared
More informationLOW PRESSURE EFFUSION OF GASES revised by Igor Bolotin 03/05/12
LOW PRESSURE EFFUSION OF GASES revised by Igor Bolotin 03/05/ This experiment will introduce you to the kinetic properties of low-pressure gases. You will make observations on the rates with which selected
More informationImproving Conventional Flotation Methods to Treat EOR Polymer Rich Produced Water
Improving Conventional Flotation Methods to Treat EOR Polymer Rich Produced Water Authors: Frank A. Richerand, Frank Richerand II Yoosef Peymani www.envirotechsystems.com OBJECTIVES Compare IGF and DGF
More informationApplication of Computational Fluid Dynamics to Compressor Efficiency Improvement
Purdue University Purdue e-pubs International Compressor Engineering Conference School of Mechanical Engineering 1994 Application of Computational Fluid Dynamics to Compressor Efficiency Improvement J.
More informationThis file was downloaded from Telemark Open Research Archive TEORA -
This file was downloaded from Telemark Open Research Archive TEORA - http://teora.hit.no/dspace/ Title: Computational study of fingering phenomenon in heavy oil reservoir with water drive Authors: Wijeratne,
More informationWalking with coffee: when and why coffee spills
Walking with coffee: when and why coffee spills Hans C. Mayer and Rouslan Krechetnikov Department of Mechanical Engineering University of California at Santa Barbara February 20-24, 2012 Page 1/25 Motivation
More informationPredicting and Controlling Bubble Clogging in Bioreactor for Bone Tissue Engineering
Predicting and Controlling Bubble Clogging in Bioreactor for Bone Tissue Engineering Marina Campolo, Dafne Molin, Alfredo Soldati Centro Interdipartimentale di Fluidodinamica e Idraulica and Department
More informationProceedings of Meetings on Acoustics
Proceedings of Meetings on Acoustics Volume 9, 2010 http://acousticalsociety.org/ 159th Meeting Acoustical Society of America/NOISE-CON 2010 Baltimore, Maryland 19-23 April 2010 Session 1pBB: Biomedical
More informationAvailable online at ScienceDirect. Procedia Engineering 112 (2015 )
Available online at www.sciencedirect.com ScienceDirect Procedia Engineering 112 (2015 ) 418 423 7th Asia-Pacific Congress on Sports Technology, APCST 2015 Comparison of the aerodynamic performance of
More informationWALL BOILING MODELING EXTENSION TOWARDS CRITICAL HEAT FLUX. ABSTRACT
WALL BOILING MODELING EXTENSION TOWARDS CRITICAL HEAT FLUX C. Lifante 1, Th. Frank 1 and A. Burns 2,3 1 ANSYS Germany GmbH, Staudenfeldweg 12, 83624 Otterfing, Germany 2 ANSYS UK, 97 Milton Park, Abingdon,
More informationWorld Academy of Science, Engineering and Technology International Journal of Mechanical and Mechatronics Engineering Vol:6, No:1, 2012
Perfect Plastic Deformation of a Circular Thin Bronze Plate due to the Growth and Collapse of a Vapour Bubble M.T. Shervani-Tabar, M. Rezaee and E. Madadi Kandjani Abstract Dynamics of a vapour bubble
More informationComputational Analysis of Cavity Effect over Aircraft Wing
World Engineering & Applied Sciences Journal 8 (): 104-110, 017 ISSN 079-04 IDOSI Publications, 017 DOI: 10.589/idosi.weasj.017.104.110 Computational Analysis of Cavity Effect over Aircraft Wing 1 P. Booma
More informationCOMPUTATIONAL FLOW MODEL OF WESTFALL'S LEADING TAB FLOW CONDITIONER AGM-09-R-08 Rev. B. By Kimbal A. Hall, PE
COMPUTATIONAL FLOW MODEL OF WESTFALL'S LEADING TAB FLOW CONDITIONER AGM-09-R-08 Rev. B By Kimbal A. Hall, PE Submitted to: WESTFALL MANUFACTURING COMPANY September 2009 ALDEN RESEARCH LABORATORY, INC.
More informationNumerical and Experimental Investigation of the Possibility of Forming the Wake Flow of Large Ships by Using the Vortex Generators
Second International Symposium on Marine Propulsors smp 11, Hamburg, Germany, June 2011 Numerical and Experimental Investigation of the Possibility of Forming the Wake Flow of Large Ships by Using the
More informationCHEMICAL ENGINEERING TRANSACTIONS
1057 A publication of CHEMICAL ENGINEERING TRANSACTIONS VOL. 56, 2017 Guest Editors: Jiří Jaromír Klemeš, Peng Yen Liew, Wai Shin Ho, Jeng Shiun Lim Copyright 2017, AIDIC Servizi S.r.l., ISBN 978-88-95608-47-1;
More informationCFD Analysis ofwind Turbine Airfoil at Various Angles of Attack
IOSR Journal of Mechanical and Civil Engineering (IOSR-JMCE) e-issn: 2278-1684,p-ISSN: 2320-334X, Volume 13, Issue 4 Ver. II (Jul. - Aug. 2016), PP 18-24 www.iosrjournals.org CFD Analysis ofwind Turbine
More informationA numerical Euler-Lagrange method for bubble tower CO2 dissolution modeling
A numerical Euler-Lagrange method for bubble tower CO2 dissolution modeling Author: Daniel Legendre & Prof. Ron Zevenhoven Åbo Akademi University Thermal and Flow Engineering Laboratory Turku, Finland
More information2 Available: 1390/08/02 Date of returning: 1390/08/17 1. A suction cup is used to support a plate of weight as shown in below Figure. For the conditio
1. A suction cup is used to support a plate of weight as shown in below Figure. For the conditions shown, determine. 2. A tanker truck carries water, and the cross section of the truck s tank is shown
More informationMODELING AND SIMULATION OF VALVE COEFFICIENTS AND CAVITATION CHARACTERISTICS IN A BALL VALVE
Proceedings of the 37 th International & 4 th National Conference on Fluid Mechanics and Fluid Power FMFP2010 December 16-18, 2010, IIT Madras, Chennai, India FMFP2010 341 MODELING AND SIMULATION OF VALVE
More informationGrid Generation for Screw Compressors with Variable Geometry Rotors
APCOM & ISCM 11-14 th December, 2013, Singapore Grid Generation for Screw Compressors with Variable Geometry Rotors Abstract *A. Kovacevic, S. Rane and N. Stosic City University London, Northampton Square,
More informationAerodynamic study of a cyclist s moving legs using an innovative approach
Aerodynamic study of a cyclist s moving legs using an innovative approach Francesco Pozzetti 30 September 2017 Abstract During a period of four weeks in September, I completed a research project in fluid
More informationTechnical Note. Determining the surface tension of liquids by measurements on pendant drops
Technical Note Pendant Drop Measurements Technical note: TN316e Industry section: all Author: FT, TW Date: 12/2010 Method: Drop Shape Analyzer DSA100 Keywords: Methods, surface tension, interfacial tension,
More informationComputational analysis of fish survival at the John Day Powerhouse
Computational analysis of fish survival at the John Day Powerhouse Jim Kiel Laurie Ebner Introduction Design a CFD model that can be used to predict the pressures in the turbine runner environment. What
More informationCFD SIMULATIONS IN AN INTERNAL CIRCULATION AIRLIFT OPERATING UNDER HOMOGENEOUS REGIME
CFD SIMULATIONS IN AN INTERNAL CIRCULATION AIRLIFT OPERATING UNDER HOMOGENEOUS REGIME P. A. S. Monteiro 1, P. Seleghim Jr. 1 1 University of São Paulo, Engineering School of São Carlos, Mechanical Engineering
More informationCFD AND EXPERIMENTAL STUDY OF AERODYNAMIC DEGRADATION OF ICED AIRFOILS
Colloquium FLUID DYNAMICS 2008 Institute of Thermomechanics AS CR, v.v.i., Prague, October 22-24, 2008 p.1 CFD AND EXPERIMENTAL STUDY OF AERODYNAMIC DEGRADATION OF ICED AIRFOILS Vladimír Horák 1, Dalibor
More informationFluid-Structure Interaction Analysis of a Flow Control Device
Abaqus Technology Brief Fluid-Structure Interaction Analysis of a Control Device TB-06-FSI-2 Revised: April 2007. Summary The Vernay VernaFlo flow controls are custom-designed fluid flow management devices
More informationNUMERICAL DERIVATION OF THE DRAG FORCE COEFFICIENT IN BUBBLE SWARMS USING A FRONT TRACKING MODEL
6th International Conference on CFD in Oil & Gas, Metallurgical and Process Industries SINTEF/NTNU, Trondheim NORWAY 0-2 June 2008 CFD08-070 NUMERICAL DERIVATION OF THE DRAG FORCE COEFFICIENT IN BUBBLE
More informationFigure 1 Schematic of opposing air bearing concept
Theoretical Analysis of Opposing Air Bearing Concept This concept utilizes air bearings to constrain five degrees of freedom of the optic as shown in the figure below. Three pairs of inherently compensated
More informationAn Innovative Solution for Water Bottling Using PET
An Innovative Solution for Water Bottling Using PET A. Castellano, P. Foti, A. Fraddosio, S. Marzano, M.D. Piccioni, D. Scardigno* DICAR Politecnico di Bari, Italy *Via Orabona 4, 70125 Bari, Italy, scardigno@imedado.poliba.it
More informationCFD Analysis of Giromill Type Vertical Axis Wind Turbine
242 CFD Analysis Giromill Type Vertical Axis Wind Turbine K. Sainath 1, T. Ravi 2, Suresh Akella 3, P. Madhu Sudhan 4 1 Associate Pressor, Department Mechanical Engineering, Sreyas Inst. Engg. & Tech.,
More informationANALYSIS OF HEAT TRANSFER THROUGH EXTERNAL FINS USING CFD TOOL
ANALYSIS OF HEAT TRANSFER THROUGH EXTERNAL FINS USING CFD TOOL B. Usha Rani 1 and M.E Thermal 2 1,2 Asst.Professor, Dadi Institute of Engineering and Technology, India Abstract-The rate of heat transfer
More informationISOLATION OF NON-HYDROSTATIC REGIONS WITHIN A BASIN
ISOLATION OF NON-HYDROSTATIC REGIONS WITHIN A BASIN Bridget M. Wadzuk 1 (Member, ASCE) and Ben R. Hodges 2 (Member, ASCE) ABSTRACT Modeling of dynamic pressure appears necessary to achieve a more robust
More informationInternational Journal of Technical Research and Applications e-issn: , Volume 4, Issue 3 (May-June, 2016), PP.
DESIGN AND ANALYSIS OF FEED CHECK VALVE AS CONTROL VALVE USING CFD SOFTWARE R.Nikhil M.Tech Student Industrial & Production Engineering National Institute of Engineering Mysuru, Karnataka, India -570008
More informationSurrounding buildings and wind pressure distribution on a high rise building
Surrounding buildings and wind pressure distribution on a high rise building Conference or Workshop Item Accepted Version Luo, Z. (2008) Surrounding buildings and wind pressure distribution on a high rise
More informationThe water supply for a hydroelectric plant is a reservoir with a large surface area. An outlet pipe takes the water to a turbine.
Fluids 1a. [1 mark] The water supply for a hydroelectric plant is a reservoir with a large surface area. An outlet pipe takes the water to a turbine. State the difference in terms of the velocity of the
More informationPurdue e-pubs. Purdue University. Stephan Lehr Technische Universitaet Dresden. Follow this and additional works at:
Purdue University Purdue e-pubs International Compressor Engineering Conference School of Mechanical Engineering 21 Numerical Investigation Of The Influence Of The Transient Flow Inside the Suction And
More informationEffect of Nozzle Twisted Lance on Jet Behavior and Spitting Rate in Top Blown Process
, pp. 1410 1414 Effect of Nozzle Twisted Lance on Jet Behavior and Spitting Rate in Top Blown Process Yoshihiko HIGUCHI and Yukari TAGO Corporate Research & Development Laboratories, Sumitomo Metal Industries,
More informationThe Study of Bubbly Gas-Water Flow Using
The Study of Bubbly Gas-Water Flow Using Displacement Current Phase Tomography Chris Zuccarelli 1, Benjamin Straiton 1, Joshua Sines 1, Qussai Marashdeh 1 1 Tech4Imaging, 1910 Crown Park Court, Columbus,
More informationEffect of Diameter on the Aerodynamics of Sepaktakraw Balls, A Computational Study
ISSN 1750-9823 (print) International Journal of Sports Science and Engineering Vol. 03 (2009) No. 01, pp. 017-021 Effect of Diameter on the Aerodynamics of Sepaktakraw Balls, A Computational Study Zahari
More informationNUMERICAL AND EXPERIMENTAL INVESTIGATION OF THE FLOWFIELD IN A BLOWDOWN WIND TUNNEL
ICAS 2002 CONGRESS NUERICAL AND EXPERIENTAL INVESTIGATION OF THE FLOWFIELD IN A BLOWDOWN WIND TUNNEL Ali Rebaine, ahmood Khalid, Cabot Broughton and Fred Ellis Institute for Aerospace Research, National
More informationCFD Flow Analysis of a Refrigerant inside Adiabatic Capillary Tube
CFD Flow Analysis of a Refrigerant inside Adiabatic Capillary Tube Y Raja Kumar ¹, Dr.P Usha sri ² PG Student¹, Associate professor² Department of Mechanical Engineering, University College of Engineering
More informationNUMERICAL SIMULATION OF DROPLET COALESCENCE AND BUBBLE ENTRAPMENT
NUMERICAL SIMULATION OF DROPLET COALESCENCE AND BUBBLE ENTRAPMENT J. Esmaeelpanah *, A. Dalili, S. Chandra, J. Mostaghimi Department of Mechanical and Industrial Engineering, University of Toronto, Toronto,
More informationInvestigation of momentum exchange term closures for the Eulerian-Eulerian model applied to bubbly flows
Graduate Theses and Dissertations Iowa State University Capstones, Theses and Dissertations 2016 Investigation of momentum exchange term closures for the Eulerian-Eulerian model applied to bubbly flows
More informationInvestigation on 3-D Wing of commercial Aeroplane with Aerofoil NACA 2415 Using CFD Fluent
Investigation on 3-D of commercial Aeroplane with Aerofoil NACA 2415 Using CFD Fluent Rohit Jain 1, Mr. Sandeep Jain 2, Mr. Lokesh Bajpai 3 1PG Student, 2 Associate Professor, 3 Professor & Head 1 2 3
More informationApplication of Simulation Technology to Mitsubishi Air Lubrication System
50 Application of Simulation Technology to Mitsubishi Air Lubrication System CHIHARU KAWAKITA *1 SHINSUKE SATO *2 TAKAHIRO OKIMOTO *2 For the development and design of the Mitsubishi Air Lubrication System
More informationNumerical Simulation of Wave Loads on Static Offshore Structures
Numerical Simulation of Wave Loads on Static Offshore Structures Hrvoje Jasak, Inno Gatin, Vuko Vukčević Wikki Ltd, United Kingdom Faculty of Mechanical Engineering and Naval Architecture University of
More informationA Numerical Study of the Flow through a Safety Butterfly Valve in a Hydro-Electric Power Scheme
16th Australasian Fluid Mechanics Conference Crown Plaza, Gold Coast, Australia 2-7 December 2007 A Numerical Study of the Flow through a Safety Butterfly Valve in a Hydro-Electric Power Scheme A. D. Henderson
More information3D CDF MODELING OF SHIP S HEELING MOMENT DUE TO LIQUID SLOSHING IN TANKS A CASE STUDY
Journal of KONES Powertrain and Transport, Vol. 17, No. 4 21 3D CDF ODELING OF SHIP S HEELING OENT DUE TO LIQUID SLOSHING IN TANKS A CASE STUDY Przemysaw Krata, Jacek Jachowski Gdynia aritime University,
More informationCFD Analysis of Supersonic Nozzle with Varying Divergent Profile
CFD Analysis of Supersonic Nozzle with Varying Divergent Profile Kaviya sundar #1, Thanikaivel Murugan. D *2 # UG Degree holder, B.E. Aeronautical Engineering, Jeppiaar Engineering college, Chennai, India,
More informationLOW PRESSURE EFFUSION OF GASES adapted by Luke Hanley and Mike Trenary
ADH 1/7/014 LOW PRESSURE EFFUSION OF GASES adapted by Luke Hanley and Mike Trenary This experiment will introduce you to the kinetic properties of low-pressure gases. You will make observations on the
More informationNumerical Fluid Analysis of a Variable Geometry Compressor for Use in a Turbocharger
Special Issue Turbocharging Technologies 15 Research Report Numerical Fluid Analysis of a Variable Geometry Compressor for Use in a Turbocharger Yuji Iwakiri, Hiroshi Uchida Abstract A numerical fluid
More information