Cross Comparisons of CFD Prediction for Wind Environment at Pedestrian Level around Buildings
|
|
- Merry Wiggins
- 5 years ago
- Views:
Transcription
1 Cross Comparisons of CFD Prediction for Wind Environment at Pedestrian Level around Buildings Part Comparison of Results for Flow-field around a High-rise Building Located in Surrounding City Blocks Ryuichiro Yoshie ) Akashi Mochida 2) Yoshihide Tominaga 3) Hiroto Kataoka 4) Masaru Yoshikawa 5) ) Tokyo Polytechnic University, Iiyama 583, Atsugi-City, Kanagawa, Japan ; yoshie@arch.t-kougei.ac.jp 2) Tohoku University, Aoba 6, Aramaki, Aoba-ku, Sendai-City, Miyagi, Japan ; mochida@sabine.pln.archi.tohoku.ac.jp 3) Niigata Institute of Technology, Fujihashi 79, Kashiwazaki-City, Niigata, Japan ; tominaga@abe.niit.ac.jp 4) Technical Research Institute, Obayashi Corp., Shimokiyoto 4-64, Kiyose-City, Tokyo, Japan ; kataoka.hiroto@obayashi.co.jp 5) Technology Center, Taisei Corp., Nasecho 344-, Totsuka-ku, Yokohama, Japan ; masaru.yoshikawa@sakura.taisei.co.jp ABSTRACT CFD is being increasingly applied to the prediction of the wind environment around high-rise buildings. However, the prediction accuracy and many factors that might affect simulation results are not yet thoroughly understood. In order to clarify ambiguities and to provide a guideline for CFD prediction of the wind environment, a working group was organized by the Architectural Institute of Japan. This group has carried out various comparative studies as follows. First stage: Flowfields around two types of single high-rise buildings. Second stage: Flowfield around a high-rise building located in a city. Last stage: Flowfields around two types of Building Complexes in actual urban areas. This paper describes the cross comparison results of the second stage. A high-rise building(25 25 m) is surrounded by low-rise city blocks(4 4 m). Wind tunnel experiments in a boundary layer using split-film probe were carried out by the present authors to obtain data for assessing the accuracy of CFD results. In the CFD simulations, the influence on prediction accuracy of calculation conditions such as boundary condition for ground surface, size of side and upper calculation region, grid system, range of surrounding city blocks, and turbulence models were investigated, and are discussed in detail.
2 INTRODUCTION Progress in high-speed processing by personal computer and rapid propagation of software for numerical analysis of fluid dynamics in recent years have enabled prediction of the pedestrian wind environment around high-rise buildings based on CFD (Computational Fluid Dynamics). It is becoming common for calculation to be performed for 6 wind directions before and after construction of buildings, and for the pedestrian wind environment to be assessed by probability evaluation. However, there have been very few reports on the prediction accuracy of CFD simulations of the pedestrian wind environment around buildings in urban areas. Furthermore, the influence of various calculation conditions (such as size of computational domain, grid resolution, boundary conditions, selection of turbulence model, etc.) on the results of CFD simulation are not yet thoroughly understood. Thus, a working group named Working Group for CFD Prediction of the Wind Environment around a Building was organized by the Architectural Institute of Japan. The name of this working group was subsequently changed to Working Group for Preparation of Wind Environment Evaluation Guideline based on CFD. Since its inception, this group has been working continuously to prepare a guideline for proper use of CFD for calculation of the wind environment. Comparative and parametric studies have been carried out on several building configurations to elucidate the problems on setting or selecting various calculation conditions and turbulence models for CFD simulation of the pedestrian wind environment [-7]. The present article introduces one of the results (flowfield around a high-rise building located in a city) and discusses the influence of calculation conditions and turbulence models on CFD calculation results. GENERAL FEATURES OF COMPARATIVE AND PARAMETRIC STUDIES Figures -6 show models for comparative and parametric studies as investigated by the working group. This paper describes the results of the study on the flowfield around a high-rise building located in a city (Figure 4). Wind b H=2b wind 4b b b 4b Figure Single high-rise building (2:: square prism) Figure 2 Single high-rise building (4:4: square prism) Figure 3 Simple city block Figure 4 High-rise building in city Figure 5 Building complexes in actual urban area (Niigata) Figure 6 Building complexes in actual urban area (Shinjuku)
3 In these studies, the standard k-ε model or modified k-ε models or DSM were used, but LES (Large Eddy Simulation) was not applied except for flowfields around two types of single prisms (Figures and 2). It is desirable to use LES to achieve highly accurate CFD [3]. However, it is very difficult to use because it requires a lot of calculation time in practical analysis due to the limited computer resources currently available. This is because prediction and evaluation of the wind environment around buildings in practical application requires a wide computational domain including surrounding building groups and a vast number of grids associated with it. In addition, a number of calculation cases (such as multiple wind directions, situations before and after construction of a building under planning, and measures after construction) are required, and time for evaluation is also limited in the practical design stages. For the time being, we must be content with RANS type models for practical use. Therefore, the guideline currently under preparation in the working group is also based on the assumption that the analysis is performed using the standard k-ε model or modified k-ε models with steady analysis. WIND TUNNEL EXPERIMENT AROUND HIGH RISE-BUILDING IN CITY General features of wind tunnel experiment The flowfield analyzed here is that around a high-rise building in a simple urban area, for which the wind tunnel experiment was carried at the Niigata Institute of Technology. The low-rise urban block was assumed to be 4m square and m high as shown in Figure 7 (simulating a condition where low-rise houses are densely jammed), with a high-rise building 25m square and m high (::4) in a block at the center of this area. One urban block is assumed to be enclosed by two roads (each m wide) and roads 2m and 3m wide. The wind velocity measuring points are shown in Figurer 8. The scale of the experimental model was /4 and the measuring height was 5mm above the floor of the wind tunnel (2m above ground in real scale). Wind velocity was measured in three wind directions (, 22.5 and 45 ) using a thermister anemometer. In addition, for wind direction only, wind velocity was measured using a split film probe. The inflow wind velocity U H at the height of the central high-rise building H (H=25mm in the experiment and m in real scale) was 6.6 m/s. Wind direction m road 3m road m m road 45 m m road Figure 7 Outline of wind tunnel experiment 4m 2m 4m 3m 4m Experiment Scale: /4 Measuring height: 5mm Figure 8 Measuring points
4 CFD STUDY ON FLOWFIELD AROUND HIGH RISE-BUILDING IN CITY Standard calculation conditions The problems with CFD analysis in an urban area, as described above, are: () How wide should the computational domain be maintained in the horizontal and vertical directions? (2) How fine should the grid resolution be? (3) To what extent should the surrounding urban blocks be reproduced? Thus, as the first part of this study, the influence of the calculation conditions was examined by varying calculation conditions ()-(3) from standard calculation conditions shown in Table and Figure 9. Table Standard calculation conditions (Calculation was carried out in experimental scale.) Computational Domain Grid resolution Scheme for advection term Building wall and ground surface Upper and side surface of computational domain Turbulence model Inflow boundary condition.8m.8m.8m (The size of the test section of the wind tunnel) 32(x) 3(y) 76(z)=,34,6 mesh (Fig.9) Quick scheme for U,V,W,k,ε Logarithmic law for smooth surface wall Free slip wall condition Standard k-εmodel Interpolated values of U and k from the experimental approaching flow ε=c μ /2 k du/dz (ε=pk ), C μ =.9 Outflow boundary condition Zero gradient condition.8m High-rise building was divided into 2(x) 2(y) 27(z).8m y x (a) Whole computational domain and grid resolution (b) Macrograph of central area Figure 9 Computational domain and grid resolution for standard calculation conditions Comparison of experimental results with CFD results based on standard calculation conditions The calculation results based on the standard calculation conditions and the experimental results measured by split film probe (EXP_S) are compared in Figure (wind direction ) and in Figure (wind direction 45 ). The wind speed ratio between the scalar wind velocity at each measuring point and U H is represented on the ordinate. At measuring points 35, 38 where the wind velocity was highest for wind directions and 45, respectively, the calculation results
5 were about 6% lower than the experimental results, while relatively good matching was observed for the other strong wind regions. CFD Figure Comparison between CFD based on standard calculation conditions and experiment (Wind direction= ) CFD Figure Comparison between CFD based on standard calculation conditions and experiment (Wind direction=45 ) Influence of various calculation conditions on CFD analysis results ) Influence of size of horizontal computational domain To evaluate the influence of the horizontal computational domain, it was expanded from the standard domain of.8m.8m to one of 3.6m 3.6m, and contracted to one of.5m.5m, which is near the rim of the surrounding block. The results are shown in Figure 2. When the horizontal computational domain was large (3.6m 3.6m), the wind speed tended to slightly decrease with decrease of the obstruction ratio in the horizontal direction. However, when the calculation was carried out in the smaller domain (l.5m.5m), the wind speed became higher. The wind speed change for the small domain was larger than that for the large domain despite the fact that the contraction was only 2% for the small domain whereas the expansion was 2% for the large domain. Therefore, it is desirable to expand the horizontal computational domain to a certain extent outside the rim of the surrounding urban block. Small(.5m.5m) Standard(.8m.8m) Large(3.6m 3.6m) Figure 2 Influence of horizontal computational domain 2) Influence of size of vertical computational domain Figure 3 shows the results obtained when the vertical computational domain was lowered from the standard height of 7.2H to 3H and 2H. When the upper computational domain was 2H,
6 the wind speed was just slightly higher. There was almost no difference between the cases of 7.2H and 3H. It appeared that no substantial problem occurred even when the vertical computational domain was lowered to about 3H. Low(2H) Middle(3H) Standard(7.2H) Figure 3 Influence of vertical computational domain 3) Influence of grid resolution Figure 4 shows the calculation results when a fine grid and a coarse grid were used. For the fine grid (25 (x) 22(y) (z) = 4,386,43), the grid width was set to about /.5 of the standard grid in all three directions x, y and z. For the coarse grid (74 (x) 68 (y) 48 (z) = 24,536), it was about.5 times the standard grid. The difference between the calculation results for the standard grid and the fine grid was very small. The difference between the calculation results for the coarse grid and the other cases was also small. The standard grid would be satisfactory, i.e. with one side of the high-rise building divided into portions or more. Coarse mesh Standard mesh Fine mesh Figure 4 Influence of grid resolution 4) Influence of reproduction range of surrounding urban blocks Figure 6 shows the results of calculation with two rows and three rows each deleted from the peripheral region of the surrounding urban blocks, as shown in Figure 5. The difference from the standard case was very small except at measuring points, 2, 3 and 4 on the roads on the windward side. Therefore, the reproduction range of the surrounding urban blocks would be satisfactory for practical application if two or more were maintained in the surroundings of the region to be evaluated. (a) deleting 2 rows (b) deleting 3rows Figure 5 Reproduction range of of surrounding urban blocks Standard Deleting 2 rows Deleting 3 rows Figure 6 Influences of reproduction range of surrounding urban blocks
7 Influence of different computational code and turbulence models Next, we investigated the influence of different computational codes and turbulence models. Table 2 shows the calculation cases. Three computational codes were compared for the standard k-ε model (wind directions:, 22.5 and 45 ), and modified k-ε models with wind direction (LK model [8], RNG model [9], Durbin model [], and mixed time scale (S-Ω) model []). Boundary conditions were unified to standard calculation conditions (see Table ) for all calculation cases. Code Case name A B C Wind direction Table 2 Calculation cases Turbulence model A-_ A-_ Standard k-ε A-_45 45 A-2_ LK k-ε A-3_ RNG k-ε B-_ B-_ Standard k-ε B-_45 45 B-2_ LK k-ε B-3_ RNG k-ε C-_ C-_ Standard k-ε C-_45 45 C-2_ Durbin C-3_ Mixed time scale Grid system Structured grid Unstructured grid Structured grid Computational method and time integral scheme SIMPLE Steady solution SIMPLE Steady solution Artificial compressibility method explisit Influence of differences of computational codes Figures 7-9 show the calculation results of Case A-, Case B- and Case C- with experimental results measured by a thermistor anemometer (EXP_T). Turbulence model was the standard k-ε model in every case. The calculated scalar wind velocities were corrected using the calculated k value to compare the experimental results measured by non-directivity thermistor anemometer (NOTE ). As a whole, the differences among the calculation results for different codes are relatively small and the wind speed ratio in CFD is evaluated somewhat lower than the experimental results. This tendency is particularly remarkable at the measuring points positioned in circulating flow region leeward of the building (for example Nos. 8-, 49-5, etc.)... A- B- C- Exp_T Figure 7 Influence of differences of computational code (Wind direction= )
8 A- B- C- Exp_T Figure 8 Influence of differences of computational code (Wind direction=22.5 ). A- B- C- Exp_T. Figure 9 Influence of differences of computational code (Wind direction=45 ) Influence of differences of turbulence models The wind speed ratios for the turbulence models for each computational code for wind velocity are compared in Figure The experiments under comparison () are based on the split film probe. There are some differences due to the influence of the turbulence models for different computational codes. The difference is rather high for code B, while it is relatively low for Code C. In all of these codes, if we see strong wind regions, the wind velocities of the LK and RNG models tends to be higher than those of the standard k-ε model, and are closer to the experimental results. Figure 23 shows the correlation between the results of CFD (Code A) and the experimental results. Although there are some discrepancies in the weak wind region, the results for the LK RNG models agree well with the experimental results in strong wind region. The results for the RNG model show somewhat better matching with experimental results than those of the LK model.
9 Standard k-ε(a-) LK(A-2) RNG(A-3) Figure 2 Influence of differences of turbulence models (Code A).... Standard k-ε(b-) LK(B-2) RNG(B-3) Figure 2 Influence of differences of turbulence models (Code B) Standard k-ε(c-) Durbin(C-2) S-Ω(C-3) Figure 22 Influence of differences of turbulence models (Code C) CFD (Standard k-ε) CFD (LK) CFD (RNG) (a) Standard k-εmodel (b) LK model (c) RNG model Figure 23 Comparison of wind speed ratio obtained from different turbulence models (Code A)
10 The horizontal distribution of wind speed ratio and turbulence energy k (standardized by U H 2 ) around the high-rise building based on Code A are shown in Figures 5 and 6. A remarkable difference is seen in the wind soeed distribution depending on the turbulence model. In the LK model, regions of.7 or more (not seen in other models) are found in the side region of the high-rise building. In the RNG model, wide regions of or more are seen in the side region. When we look at the circulating flow behind the high-rise building, isoplethic curves are denser in two modified models than in the standard k-ε model, indicating that stronger circulating flows are reproduced there. This is attributed to the fact that stronger separation flows occur at the side region than in the standard k-ε model, and this causes stronger collision with the leeward low-rise block. In the k distribution, the peak value of k appears on windward side of the high-rise building in the standard k-ε model, and this is why the wind speeds at the side region of the high-rise building were evaluated lower. In the LK model, the peak value of k (region of.4 or more), unlike in the other models, is observed near the region behind the windward building. (a) Standard k-εmodel (b) LK model RNG model Distribution of wind speed ratio (Wind direction, Code A) (a) Standard k-εmodel (b) LK model RNG model Distribution of turbulence energy k (Wind direction, Code A) CONCLUSION According to the results of the present study, the influence on the calculation results of the computational domain, the grid resolution, and the reproduction range of the surrounding urban block is relatively low. In the calculation for practical application, the condition setting criteria can be expressed as follows: Two or more urban blocks each of several tens of meters should be reproduced in the area surrounding the region to be evaluated The horizontal computational domain should be maintained to a certain extent outside the rim of the surrounding urban block. The vertical computational domain should be maintained at 3H or more One side of the high-rise building should be divided into portions or more.
11 The differences among the results for different computational codes were relatively small. The difference due to the codes tends to be higher in the circulating flow region behind the building than in the strong wind region. In the strong wind region, the wind speed ratios of modified k-εmodels agreed well with the experimental results compared with the standard k-ε model. If it is limited to the highest wind region, which is important for evaluation of the pedestrian wind environment around the building, the wind speed difference between CFD and experiment was several tens of % at most for the standard k-ε model. For the LK model and the RNG model, more accurate prediction can be made in the strong wind region. ACKNOWLEDGEMENT We express our sincere gratitude to the members of the Working Group for Preparation of Wind Environment Evaluation Guideline Based on CFD for useful and valuable advice. This study was partially funded by the Ministry of Education, Culture, Sports, Science and Technology, Japan, through the 2 st Century Center of Excellence Program of Tokyo Polytechnic University. NOTE The mean scalar velocity measured in the wind tunnel using a non-directive thermistor anemometer (S exp ) is regarded as the time averaged instantaneous scalar velocity, which can be expressed as: S exp =<(u 2 +v 2 +w 2 ) /2 >. However, the mean scalar velocity given from CFD (S CFD ) is calculated from the time averaged velocity vector, namely, S CFD =(<u> 2 +<v> 2 +<w> 2 ) /2. Thus, the output of the thermistor anemometer is larger than that given by CFD. S exp =<(u 2 +v 2 +w 2 ) /2 > =<{(<u>+u ) 2 +(<v>+v ) 2 +(<w>+w ) 2 } /2 > =<(<u> 2 +<v> 2 +<w> 2 +<u 2 +v 2 +w 2 >) /2 > =(<u> 2 +<v> 2 +<w> 2 +2k) /2 =(S 2 CFD +2k) /2 Here, u,v,w: three components of instantaneous velocity vector, <f>: time-averaged value of f, f =f-<f>. The mean scalar velocity given from CFD(S exp ) was corrected as S exp =(S 2 CFD +2k) /2 when compared with the experimental results measured by a thermistor anemometer. However, this correction does not completely express the influence of velocity fluctuation included in the experimental results measured by the thermistor anemometer.
12 REFERENCES []Working Group for CFD Prediction of Wind Environment Around Building (2), Development of CFD method for predicting wind environment around a high-rise building, Part: The cross comparison of CFD results using various k-ε models, AIJ Journal of Technology and Design, No.2, 9-24, 2.(written in Japanese) [2] Mochida, A., Tominaga, Y., Murakami, S., Yoshie, R., Ishihara, T., and Ooka, R. (22), Comparison of various k-ε models and DSM applied to flow around a high-rise building -report on AIJ cooperative project for CFD prediction on wind environment, Wind&Structures, Vol.5, No.2~4, pp [3] Tominaga, Y., Mochida, A., Murakami, S. (23), Large Eddy Simulation of Flowfield around a High-rise Building, th International Conference on Wind engineering, B-5. [4]Shirasawa, T., Mochida, A., Tominaga, Y., Yoshie, R., Kataoka, H., Nozu T. and Yoshino, H. (23), Development of CFD method for predicting wind environment around a high-rise building, Part2: The cross comparison of CFD results on the flow field around a 4:4: prism, AIJ Journal of Technology and Design, No.8, (written in Japanese) [5] Tominagada, Y., Mochida, A., Shirasawa, T., Yoshie, R., Kataoka, H., Harimoto, K. and Nozu, T. (24), Cross Comparisons of CFD results of wind environment at pedistrian level around a high-rise building and within a building complex, Journal of Asian Architecture and Building Engineering, vol.3 no., pp [6] Tominagada, Y., Mochida, A., Harimoto, K., Kataoka, H., Yoshie, R. (24), Development of CFD method for predicting wind environment around a high-rise building, Part3: The cross comparison of results for wind environment around building complex in actual urban area using different CFD codes, AIJ Journal of Technology and Design, No.9, (written in Japanese) [7] Tominagada, Yoshie, R., Mochida, A., Kataoka, H., Harimoto, K., Shirasawa, T. (25), Cross Comparisons of CFD Prediction for Wind Environment at Pedestrian Level around Buildings, Part 2 Comparison of results for flow-field around building complex in actual urban area, The sixth Asia-Pacific Conference on Wind Engineering (to be submitted). [8] Kato, M. and Launder, B.E. (993), The modelling of turbulent flow around stationary and vibrating square cylinders, 9th Symposium on Turbulent Shear Flows, pp.-4. [9]Yakhot, V. and Orszag, S. A. (986), Renormalization Group Analysis of Turbulence, Journal of Scientific Computing, Vol., No., pp.3-5. []Durbin, P. A.(996), On the k-e stagnation point anomaly, Int. J. Heat and Fluid Flow, 7, [] Nagano, Y., and Hattori, H. (23), A New Low-Reynolds-Number Turbulence Model with
13 Hybrid Time-Scales of Mean Flow and Turbulence for Complex Wall Flows, Proceedings of 4th International Symp. on Turbulence, Heat and Mass Transfer, Antalya, Turkey, pp
Cooperative roject for CFD rediction of edestrian ind nvironment in the Architectural Institute of Japan
EACWE4 The Fourth European & African Conference on Wind Engineering J. Náprstek & C. Fischer (eds); ITAM AS CR, Prague, 11-15 July, 2005, Paper #292 Cooperative roject for CFD rediction of edestrian ind
More informationCooperative project for CFD prediction of pedestrian wind environment in the Architectural Institute of Japan
Journal of Wind Engineering and Industrial Aerodynamics 95 (27) 55 578 www.elsevier.com/locate/jweia Cooperative project for CFD prediction of pedestrian wind environment in the Architectural Institute
More informationCOMPARISONS OF COMPUTATIONAL FLUID DYNAMICS AND
The Seventh Asia-Pacific Conference on Wind Engineering, November 8-12, 2009, Taipei, Taiwan COMPARISONS OF COMPUTATIONAL FLUID DYNAMICS AND WIND TUNNEL EXPERIMENTS FOR PEDESTRIAN WIND ENVIRONMENTS Chin-Hsien
More informationSurrounding buildings and wind pressure distribution on a high rise building
Surrounding buildings and wind pressure distribution on a high rise building Conference or Workshop Item Accepted Version Luo, Z. (2008) Surrounding buildings and wind pressure distribution on a high rise
More informationRESEARCH ON MEASUREMENT AND SIMULATION OF THE WIND ENVIRON- MENT AROUND BUILDINGS IN CAMPUS
Eleventh International IBPSA Conference Glasgow, Scotland July 27-30, 2009 RESEARCH ON MEASUREMENT AND SIMULATION OF THE WIND ENVIRON- MENT AROUND BUILDINGS IN CAMPUS Bing Wang 1, Borong Lin 1,* 1Deparment
More informationNumerical analysis of surface pressure coefficients for a building with balconies
Numerical analysis of surface pressure coefficients for a building with balconies Montazeri H., Blocken B. Building Physics and Services, Eindhoven University of Technology, P.O. box 513, 5600 MB Eindhoven,
More informationa high-rise (78 m) building in the city of Antwerp. CFD simulations are performed for the building with and without second-skin facade concept impleme
The Seventh International Colloquium on Bluff Body Aerodynamics and Applications (BBAA7) Shanghai, China; September 2-6, 2012 CFD analysis of wind comfort on high-rise building balconies: validation and
More informationCOMPARISON BETWEEN THE WIND TUNNEL EXPERIMANT AND CFD ANALYSIS INTENDED FOR APARTMENT HOUSE STUDY OF STUNDARD K-E MODEL AND DURBIN MODEL
Proceedings of B25: 4th Conference of International Building Performance imulation Association, Hyderabad, India, Dec. 7-9, 25. COMPARION BETWEEN THE WIND TUNNEL EXPERIMANT AND CFD ANALYI INTENDED FOR
More informationEFFECT OF CORNER CUTOFFS ON FLOW CHARACTERISTICS AROUND A SQUARE CYLINDER
EFFECT OF CORNER CUTOFFS ON FLOW CHARACTERISTICS AROUND A SQUARE CYLINDER Yoichi Yamagishi 1, Shigeo Kimura 1, Makoto Oki 2 and Chisa Hatayama 3 ABSTRACT It is known that for a square cylinder subjected
More informationNumerical investigation on the effect of overhang roof around rural house
Numerical investigation on the effect of overhang roof around rural house *Taksiah A. Majid 1), Shaharudin Shah Zaini 2), Mohd Azmi Ismail 3), Siti Noratikah Che Deraman 4) and Jing Lin Poon 5) 1), 2),
More informationImproving pedestrian wind comfort around a high rise building in an urban area: a case study by CFD simulations and on-site measurements
Improving pedestrian wind comfort around a high rise building in an urban area: a case study by CFD simulations and on-site measurements WD Janssen, B Blocken, and T van Hooff Unit Building Physics and
More informationNUMERICAL SIMULATION OF STATIC INTERFERENCE EFFECTS FOR SINGLE BUILDINGS GROUP
NUMERICAL SIMULATION OF STATIC INTERFERENCE EFFECTS FOR SINGLE BUILDINGS GROUP Xing-qian Peng, Chun-hui Zhang 2 and Chang-gui Qiao 2 Professor, College of Civil Engineering, Huaqiao University, Quanzhou,
More informationNumerical simulation of topographic effects on wind flow fields over complex terrain
The Eighth Asia-Pacific Conference on Wind Engineering, December 10 14, 2013, Chennai, India Numerical simulation of topographic effects on wind flow fields over complex terrain B.W. Yan 1, Q.S. LI 2,
More informationWind Flow Model of Area Surrounding the Case Western Reserve University Wind Turbine
Wind Flow Model of Area Surrounding the Case Western Reserve University Wind Turbine Matheus C. Fernandes 1, David H. Matthiesen PhD *2 1 Case Western Reserve University Dept. of Mechanical Engineering,
More informationWind Flow Validation Summary
IBHS Research Center Validation of Wind Capabilities The Insurance Institute for Business & Home Safety (IBHS) Research Center full-scale test facility provides opportunities to simulate natural wind conditions
More informationComputational evaluation of pedestrian wind comfort and wind safety around a high-rise building in an urban area
International Environmental Modelling and Software Society (iemss) 7th Intl. Congress on Env. Modelling and Software, San Diego, CA, USA, Daniel P. Ames, Nigel W.T. Quinn and Andrea E. Rizzoli (Eds.) http://www.iemss.org/society/index.php/iemss-2014-proceedings
More informationNumerical Fluid Analysis of a Variable Geometry Compressor for Use in a Turbocharger
Special Issue Turbocharging Technologies 15 Research Report Numerical Fluid Analysis of a Variable Geometry Compressor for Use in a Turbocharger Yuji Iwakiri, Hiroshi Uchida Abstract A numerical fluid
More informationWind tunnel test and numerical simulation of wind pressure on a high-rise building
Journal of Chongqing University (English Edition) [ISSN 1671-8224] Vol. 9 No. 1 March 2010 Article ID: 1671-8224(2010)01-0047-07 To cite this article: AL ZOUBI Feras, LI Zheng-liang, WEI Qi-ke, SUN Yi.
More informationInfluence of rounding corners on unsteady flow and heat transfer around a square cylinder
Influence of rounding corners on unsteady flow and heat transfer around a square cylinder S. K. Singh Deptt. of Mech. Engg., M. B. M. Engg. College / J. N. V. University, Jodhpur, Rajasthan, India Abstract
More informationMany elite cyclists therefore try to optimise their position for drag by means of field tests or wind tunnel tests. More recently, also Computational
The Seventh International Colloquium on Bluff Body Aerodynamics and Applications (BBAA7) Shanghai, China; September 2-6, 2012 RANS and LES simulations of the interference drag of two cyclists B. Blocken
More informationSTUDY ON TSUNAMI PROPAGATION INTO RIVERS
ABSTRACT STUDY ON TSUNAMI PROPAGATION INTO RIVERS Min Roh 1, Xuan Tinh Nguyen 2, Hitoshi Tanaka 3 When tsunami wave propagation from the narrow river mouth, water surface is raised and fluctuated by long
More informationNumerical and Experimental Investigation of the Possibility of Forming the Wake Flow of Large Ships by Using the Vortex Generators
Second International Symposium on Marine Propulsors smp 11, Hamburg, Germany, June 2011 Numerical and Experimental Investigation of the Possibility of Forming the Wake Flow of Large Ships by Using the
More informationEFFECTS OF SIDEWALL OPENINGS ON THE WIND LOADS ON PIPE-FRAMED GREENHOUSES
The Seventh Asia-Pacific Conference on Wind Engineering, November 8-12, 29, Taipei, Taiwan EFFECTS OF SIDEWALL OPENINGS ON THE WIND LOADS ON PIPE-FRAMED GREENHOUSES Yasushi Uematsu 1, Koichi Nakahara 2,
More informationApplication of Simulation Technology to Mitsubishi Air Lubrication System
50 Application of Simulation Technology to Mitsubishi Air Lubrication System CHIHARU KAWAKITA *1 SHINSUKE SATO *2 TAKAHIRO OKIMOTO *2 For the development and design of the Mitsubishi Air Lubrication System
More informationInvestigations on the Aerodynamic Forces of 2-D Square Lattice Tower Section Using CFD
J. Energy Power Sources Vol. 1, No. 5, 2014, pp. 270-277 Received: August 14, 2014, Published: November 30, 2014 Journal of Energy and Power Sources www.ethanpublishing.com Investigations on the Aerodynamic
More informationClarification of Behavior of Huge Tsunami Action on Bridges - Hydraulic Model Experiment and Simulation Technology -
Clarification of Behavior of Huge Tsunami Action on Bridges - Hydraulic Model Experiment and Simulation Technology - 21 TOSHIMITSU SUZUKI *1 RIKUMA SHIJO *2 KAORU YOKOYAMA *3 SYUNICHI IKESUE *4 HIROFUMI
More informationTHEORETICAL EVALUATION OF FLOW THROUGH CENTRIFUGAL COMPRESSOR STAGE
THEORETICAL EVALUATION OF FLOW THROUGH CENTRIFUGAL COMPRESSOR STAGE S.Ramamurthy 1, R.Rajendran 1, R. S. Dileep Kumar 2 1 Scientist, Propulsion Division, National Aerospace Laboratories, Bangalore-560017,ramamurthy_srm@yahoo.com
More informationAerodynamic Performance of Trains with Different Longitudinal Section Lines under Crosswind
2017 2nd International Conference on Industrial Aerodynamics (ICIA 2017) ISBN: 978-1-60595-481-3 Aerodynamic Performance of Trains with Different Longitudinal Section Lines under Crosswind Taizhong Xie
More informationHigh Swept-back Delta Wing Flow
Advanced Materials Research Submitted: 2014-06-25 ISSN: 1662-8985, Vol. 1016, pp 377-382 Accepted: 2014-06-25 doi:10.4028/www.scientific.net/amr.1016.377 Online: 2014-08-28 2014 Trans Tech Publications,
More informationLABORATORY EXPERIMENTS ON WAVE OVERTOPPING OVER SMOOTH AND STEPPED GENTLE SLOPE SEAWALLS
Asian and Pacific Coasts 23 LABORATORY EXPERIMENTS ON WAVE OVERTOPPING OVER SMOOTH AND STEPPED GENTLE SLOPE SEAWALLS Takayuki Suzuki 1, Masashi Tanaka 2 and Akio Okayasu 3 Wave overtopping on gentle slope
More informationTHREE DIMENSIONAL STRUCTURES OF FLOW BEHIND A
The Seventh Asia-Pacific Conference on Wind Engineering, November 8-12, 29, Taipei, Taiwan THREE DIMENSIONAL STRUCTURES OF FLOW BEHIND A SQUARE PRISM Hiromasa Kawai 1, Yasuo Okuda 2 and Masamiki Ohashi
More informationCFD Analysis ofwind Turbine Airfoil at Various Angles of Attack
IOSR Journal of Mechanical and Civil Engineering (IOSR-JMCE) e-issn: 2278-1684,p-ISSN: 2320-334X, Volume 13, Issue 4 Ver. II (Jul. - Aug. 2016), PP 18-24 www.iosrjournals.org CFD Analysis ofwind Turbine
More informationDetermination of the wind pressure distribution on the facade of the triangularly shaped high-rise building structure
Determination of the wind pressure distribution on the facade of the triangularly shaped high-rise building structure Norbert Jendzelovsky 1,*, Roland Antal 1 and Lenka Konecna 1 1 STU in Bratislava, Faculty
More informationSIMULATION OF THE FLOW FIELD CHARACTERISTICS OF TRANSIENT FLOW
The Seventh Asia-Pacific Conference on Wind Engineering, November 8-12, 2009, Taipei, Taiwan SIMULATION OF THE FLOW FIELD CHARACTERISTICS OF TRANSIENT FLOW S. Cao 1, Y. Zhao 2, H. Ozono, Y. Tamura, A.Kareem
More informationEffect of Diameter on the Aerodynamics of Sepaktakraw Balls, A Computational Study
ISSN 1750-9823 (print) International Journal of Sports Science and Engineering Vol. 03 (2009) No. 01, pp. 017-021 Effect of Diameter on the Aerodynamics of Sepaktakraw Balls, A Computational Study Zahari
More informationWindsimulaties op de meteorologische microschaal
Windsimulaties op de meteorologische microschaal dr.ir. Twan van Hooff prof.dr.ir. Bert Blocken Building Physics Section KU Leuven Unit Building Physics and Services TU/e 2015 Twan van Hooff All Rights
More informationPressure coefficient on flat roofs of rectangular buildings
Pressure coefficient on flat roofs of rectangular buildings T. Lipecki 1 1 Faculty of Civil Engineering and Architecture, Lublin University of Technology, Poland. t.lipecki@pollub.pl Abstract The paper
More informationMeasurement and simulation of the flow field around a triangular lattice meteorological mast
Measurement and simulation of the flow field around a triangular lattice meteorological mast Matthew Stickland 1, Thomas Scanlon 1, Sylvie Fabre 1, Andrew Oldroyd 2 and Detlef Kindler 3 1. Department of
More informationNumerical Analysis of the Propeller with Economical Cap by CFD
Numerical Analysis of the Propeller with Economical Cap by CFD 1.Introduction Yoshihisa Okada*, Kenta Katayama* and Akinori Okazaki* Propeller Design department, Nakashima Propeller Co.,Ltd. 688-1, Joto-Kitagata,
More informationAIRFLOW GENERATION IN A TUNNEL USING A SACCARDO VENTILATION SYSTEM AGAINST THE BUOYANCY EFFECT PRODUCED BY A FIRE
- 247 - AIRFLOW GENERATION IN A TUNNEL USING A SACCARDO VENTILATION SYSTEM AGAINST THE BUOYANCY EFFECT PRODUCED BY A FIRE J D Castro a, C W Pope a and R D Matthews b a Mott MacDonald Ltd, St Anne House,
More informationYasuyuki Hirose 1. Abstract
Study on Tsunami force for PC box girder Yasuyuki Hirose 1 Abstract In this study, a waterway experiment was performed in order to understand the influence of tsunami forms on tsunami forces acting on
More informationFull scale measurements and simulations of the wind speed in the close proximity of the building skin
Full scale measurements and simulations of the wind speed in the close proximity of the building skin Radoslav Ponechal 1,* and Peter Juras 1 1 University of Zilina, Faculty of Civil Engineering, Department
More informationCFD AND EXPERIMENTAL STUDY OF AERODYNAMIC DEGRADATION OF ICED AIRFOILS
Colloquium FLUID DYNAMICS 2008 Institute of Thermomechanics AS CR, v.v.i., Prague, October 22-24, 2008 p.1 CFD AND EXPERIMENTAL STUDY OF AERODYNAMIC DEGRADATION OF ICED AIRFOILS Vladimír Horák 1, Dalibor
More informationErmenek Dam and HEPP: Spillway Test & 3D Numeric-Hydraulic Analysis of Jet Collision
Ermenek Dam and HEPP: Spillway Test & 3D Numeric-Hydraulic Analysis of Jet Collision J.Linortner & R.Faber Pöyry Energy GmbH, Turkey-Austria E.Üzücek & T.Dinçergök General Directorate of State Hydraulic
More informationWind loading on cladding and glazed façades
Wind loading on cladding and glazed façades Dr Mauro OVEREND Lecturer in Architectural Structures School of the Built Environment, University of Nottingham UK Kenneth ZAMMIT PhD Student School of the Built
More informationPerformance Evaluation of Four-Sided Square Wind Catchers with Different Geometries by Numerical Method
Article Performance Evaluation of Four-Sided Square Wind Catchers with Different Geometries by Numerical Method Maryam Hossein Ghadiri 1,a, Nik Lukman Nik Ibrahim 1,b, and Mohd Farid Mohamed 2,c 1, 2 Department
More informationWind pressure coefficient determination for greenhouses built in a reclaimed land using CFD technique
Ref: 1064 Wind pressure coefficient determination for greenhouses built in a reclaimed land using CFD technique Hyun-seob Hwang and In-bok Lee, Department of Rural Systems Engineering, Research Institute
More informationNUMERICAL INVESTIGATION OF THE FLOW BEHAVIOUR IN A MODERN TRAFFIC TUNNEL IN CASE OF FIRE INCIDENT
- 277 - NUMERICAL INVESTIGATION OF THE FLOW BEHAVIOUR IN A MODERN TRAFFIC TUNNEL IN CASE OF FIRE INCIDENT Iseler J., Heiser W. EAS GmbH, Karlsruhe, Germany ABSTRACT A numerical study of the flow behaviour
More informationSPECTRAL CHARACTERISTICS OF FLUCTUATING WIND LOADS ON A SEPARATE TWIN-BOX DECK WITH CENTRAL SLOT
The Seventh Asia-Pacific Conference on Wind Engineering, November 8-, 009, Taipei, Taiwan SPECTRAL CHARACTERISTICS OF FLUCTUATING WIND LOADS ON A SEPARATE TWIN-BOX DEC WITH CENTRAL SLOT Le-Dong Zhu, Shui-Bing
More informationPhD student, January 2010-December 2013
Numerical modeling of wave current interactions ata a local scaleand and studyof turbulence closuremodel effects MARIA JOÃO TELES PhD student, January 2010-December 2013 Supervisor: António Pires-Silva,
More informationMODELING THE PERFORMANCE OF PERSONALIZED VENTILATION UNDER DIFFERENT ROOM AIRFLOWS
Ninth International IBPSA Conference Montréal, Canada August 15-18, 2005 MODELING THE PERFORMANCE OF PERSONALIZED VENTILATION UNDER DIFFERENT ROOM AIRFLOWS Naiping Gao *, Jianlei Niu Department of Building
More informationA CFD ANALYSIS OF VENTILATION SYSTEM OF LAVATORY IN OFFICE BUILDING , Higashi-mita, Tama-ku, Kawasaki, Japan
Proceedings: Building imulation 007 A CFD ANALYI OF VENTILATION YTEM OF LAVATORY IN OFFICE BILDING Koji akai, Yasutaka Murata, Ryutaro Kubo and Ryoichi Kajiya Department of Architecture, Meiji niversity,
More informationFree Surface Flow Simulation with ACUSIM in the Water Industry
Free Surface Flow Simulation with ACUSIM in the Water Industry Tuan Ta Research Scientist, Innovation, Thames Water Kempton Water Treatment Works, Innovation, Feltham Hill Road, Hanworth, TW13 6XH, UK.
More informationDUE TO EXTERNAL FORCES
17B.6 DNS ON GROWTH OF A VERTICAL VORTEX IN CONVECTION DUE TO EXTERNAL FORCES Ryota Iijima* and Tetsuro Tamura Tokyo Institute of Technology, Yokohama, Japan 1. INTRODUCTION Various types of vertical vortices,
More informationREVIEW Effects of Side Vents and Span Numbers on Wind-Induced Natural Ventilation of a Gothic Multi-Span Greenhouse
JARQ 38 (4), 7 33 (004) http://www.jircas.affrc.go.jp REVIEW Effects of Side Vents and Span Numbers on Wind-Induced Natural Ventilation of a Gothic Multi-Span Greenhouse Murat KACIRA 1,, Sadanori SASE
More informationWind tunnel effects on wingtip vortices
48th AIAA Aerospace Sciences Meeting Including the New Horizons Forum and Aerospace Exposition 4-7 January 2010, Orlando, Florida AIAA 2010-325 Wind tunnel effects on wingtip vortices Xin Huang 1, Hirofumi
More informationNumerical Investigation of Multi Airfoil Effect on Performance Increase of Wind Turbine
International Journal of Engineering & Applied Sciences (IJEAS) International Journal of Engineering Applied Sciences (IJEAS) Vol.9, Issue 3 (2017) 75-86 Vol.x, Issue x(201x)x-xx http://dx.doi.org/10.24107/ijeas.332075
More informationCFD Simulation and Experimental Validation of a Diaphragm Pressure Wave Generator
CFD Simulation and Experimental Validation of a Diaphragm Pressure Wave Generator T. Huang 1, A. Caughley 2, R. Young 2 and V. Chamritski 1 1 HTS-110 Ltd Lower Hutt, New Zealand 2 Industrial Research Ltd
More informationCFD Study of Solid Wind Tunnel Wall Effects on Wing Characteristics
Indian Journal of Science and Technology, Vol 9(45), DOI :10.17485/ijst/2016/v9i45/104585, December 2016 ISSN (Print) : 0974-6846 ISSN (Online) : 0974-5645 CFD Study of Solid Wind Tunnel Wall Effects on
More informationJournal of Engineering Science and Technology Review 9 (5) (2016) Research Article. CFD Simulations of Flow Around Octagonal Shaped Structures
Jestr Journal of Engineering Science and Technology Review 9 (5) (2016) 72-76 Research Article JOURNAL OF Engineering Science and Technology Review www.jestr.org CFD Simulations of Flow Around Octagonal
More informationPredicting the Suction Gas Superheating in Reciprocating Compressors
Purdue University Purdue e-pubs International Compressor Engineering Conference School of Mechanical Engineering 2014 Predicting the Suction Gas Superheating in Reciprocating Compressors Jonatas Ferreira
More informationNumerical Analysis of Wind loads on Tapered Shape Tall Buildings
IJSTE - International Journal of Science Technology & Engineering Volume 1 Issue 11 May 2015 ISSN (online): 2349-784X Numerical Analysis of Wind loads on Tapered Shape Tall Buildings Ashwin G Hansora Assistant
More informationINTERFERENCE EFFECTS OF TWO BUILDINGS ON PEAK WIND PRESSURES
The Seventh Asia-Pacific Conference on Wind Engineering, November 8-, 9, Taipei, Taiwan INTERFERENCE EFFECTS OF TWO BUILDINGS ON PEAK WIND PRESSURES Wonsul Kim, Yukio Tamura and Akihito Yoshida 3 Ph.D.
More informationAvailable online at ScienceDirect. Procedia Engineering 161 (2016 )
Available online at www.sciencedirect.com ScienceDirect Procedia Engineering 161 (216 ) 1845 1851 World Multidisciplinary Civil Engineering-Architecture-Urban Planning Symposium 216, WMCAUS 216 Experimental
More information7 JAXA Special Publication JAXA-SP--8E the internal wall surface of the tower at the three different levels shown in Figure. Strain (in the vertical d
First International Symposium on Flutter and its Application, 739 Wind Loads on a Bottom-mounted Offshore Wind Turbine Tower Kazumasa OKUBO +, Manabu YAMAMOTO +, Yukinari FUKUMOTO +3 and Takeshi ISHIHARA
More informationWorkshop 1: Bubbly Flow in a Rectangular Bubble Column. Multiphase Flow Modeling In ANSYS CFX Release ANSYS, Inc. WS1-1 Release 14.
Workshop 1: Bubbly Flow in a Rectangular Bubble Column 14. 5 Release Multiphase Flow Modeling In ANSYS CFX 2013 ANSYS, Inc. WS1-1 Release 14.5 Introduction This workshop models the dispersion of air bubbles
More informationPrediction and evaluation method of wind environment in the early design stage using BIMbased CFD simulation
IOP Conference Series: Materials Science and Engineering Prediction and evaluation method of wind environment in the early design stage using BIMbased CFD simulation To cite this article: Sumi Lee and
More informationAerodynamic study of a cyclist s moving legs using an innovative approach
Aerodynamic study of a cyclist s moving legs using an innovative approach Francesco Pozzetti 30 September 2017 Abstract During a period of four weeks in September, I completed a research project in fluid
More informationThe Usage of Propeller Tunnels For Higher Efficiency and Lower Vibration. M. Burak Şamşul
The Usage of Propeller Tunnels For Higher Efficiency and Lower Vibration M. Burak Şamşul ITU AYOC 2014 - Milper Pervane Teknolojileri Company Profile MILPER is established in 2011 as a Research and Development
More informationNumerical Simulations of a Train of Air Bubbles Rising Through Stagnant Water
Numerical Simulations of a Train of Air Bubbles Rising Through Stagnant Water Hong Xu, Chokri Guetari ANSYS INC. Abstract Transient numerical simulations of the rise of a train of gas bubbles in a liquid
More informationA numerical simulation of oil spill in Istanbul strait
Coastal Engineering 135 A numerical simulation of oil spill in Istanbul strait S. Can 1, S. Nishio 2 & M. Uchida 2 1 Maritime Faculty Istanbul Technical University, Turkey 2 Faculty of Maritime Sciences,
More informationThe evolution of the application of CFD on pedestrian wind comfort in engineering practice, a validation study
EACWE 5 Florence, Italy 19 th 23 rd July 2009 Flying Sphere image Museo Ideale L. Da Vinci The evolution of the application of CFD on pedestrian wind comfort in engineering practice, a validation study
More informationDNS Study on Three Vortex Identification Methods
Γ DNS Study on Three Vortex Identification Methods Yinlin Dong Yong Yang Chaoqun Liu Technical Report 2016-07 http://www.uta.edu/math/preprint/ DNS Study on Three Vortex Identification Methods Yinlin Dong
More informationSCREENING OF TOPOGRAPHIC FACTOR ON WIND SPEED ESTIMATION WITH NEURAL NETWORK ANALYSIS
The Seventh Asia-Pacific Conference on Wind Engineering, November 8-12, 2009, Taipei, Taiwan SCREENING OF TOPOGRAPHIC FACTOR ON WIND SPEED ESTIMATION WITH NEURAL NETWORK ANALYSIS Fumiaki Nagao 1 Minoru
More informationDevelopment of Technology to Estimate the Flow Field around Ship Hull Considering Wave Making and Propeller Rotating Effects
Development of Technology to Estimate the Flow Field around Ship Hull Considering Wave Making and Propeller Rotating Effects 53 MAKOTO KAWABUCHI *1 MASAYA KUBOTA *1 SATORU ISHIKAWA *2 As can be seen from
More informationDevelopment of virtual 3D human manikin with integrated breathing functionality
SAT-9.2-2-HT-06 Development of virtual 3D human manikin with integrated breathing functionality Martin Ivanov Development of virtual 3D human manikin with integrated breathing functionality: The presented
More informationEXPERIMENTAL STUDY OF WIND PRESSURES ON IRREGULAR- PLAN SHAPE BUILDINGS
BBAA VI International Colloquium on: Bluff Bodies Aerodynamics & Applications Milano, Italy, July, 2-24 8 EXPERIMENTAL STUDY OF WIND PRESSURES ON IRREGULAR- PLAN SHAPE BUILDINGS J. A. Amin and A. K. Ahuja
More informationCFD Analysis of Effect of Variation in Angle of Attack over NACA 2412 Airfoil through the Shear Stress Transport Turbulence Model
IJSRD - International Journal for Scientific Research & Development Vol. 5, Issue 02, 2017 ISSN (online): 2321-0613 CFD Analysis of Effect of Variation in Angle of Attack over NACA 2412 Airfoil through
More informationOriginal Publication: International Journal of High-Rise Buildings Volume 2 Number 2
ctbuh.org/papers Title: Authors: Subject: Keywords: Air Pollutant Dispersion Phenomena at a Street under a Sky Train Station in Bangkok, Thailand Kyosuke Hiyama, Yamaguchi University Tomomi Hoshiko, University
More informationFriction properties of the face of a hand-held tennis racket
Available online at www.sciencedirect.com Procedia Engineering 34 (2012 ) 544 549 9 th Conference of the International Sports Engineering Association (ISEA) Friction properties of the face of a hand-held
More informationOPTIMIZATION OF SINGLE STAGE AXIAL FLOW COMPRESSOR FOR DIFFERENT ROTATIONAL SPEED USING CFD
http:// OPTIMIZATION OF SINGLE STAGE AXIAL FLOW COMPRESSOR FOR DIFFERENT ROTATIONAL SPEED USING CFD Anand Kumar S malipatil 1, Anantharaja M.H 2 1,2 Department of Thermal Power Engineering, VTU-RO Gulbarga,
More informationCYCLE ANALYSIS OF LINEAR COMPRESSORS USING THREE- DIMENSIONAL CFD
CYCLE ANALYSIS OF LINEAR COMPRESSORS USING THREE- DIMENSIONAL CFD I. Y. An and Y. L. Lee Department of Mechanical Engineering, Kongju National University, Korea E-Mail: ylee@kongju.ac.kr ABSTRACT In order
More informationRESEARCH ON STABILITY OF OPENING SECTION AT BAYMOUTH BREAKWATER Junichiro SAKUNAKA 1 and Taro ARIKAWA 2
RESEARCH ON STABILITY OF OPENING SECTION AT BAYMOUTH BREAKWATER Junichiro SAKUNAKA 1 and Taro ARIKAWA 2 The baymouth breakwater is to protect the port area from tsunami. It narrows the bay mouth and prevents
More informationInternational Journal of Technical Research and Applications e-issn: , Volume 4, Issue 3 (May-June, 2016), PP.
DESIGN AND ANALYSIS OF FEED CHECK VALVE AS CONTROL VALVE USING CFD SOFTWARE R.Nikhil M.Tech Student Industrial & Production Engineering National Institute of Engineering Mysuru, Karnataka, India -570008
More informationAerodynamic Measures for the Vortex-induced Vibration of π-shape Composite Girder in Cable-stayed Bridge
Aerodynamic Measures for the Vortex-induced Vibration of π-shape Composite Girder in Cable-stayed Bridge *Feng Wang 1), Jialing Song 2), Tuo Wu 3), and Muxiong Wei 4) 1), 2, 3), 4) Highway School, Chang
More informationOPTIMIZATION OF INERT GAS FLOW INSIDE LASER POWDER BED FUSION CHAMBER WITH COMPUTATIONAL FLUID DYNAMICS. Abstract. Introduction
Solid Freeform Fabrication 2018: Proceedings of the 29th Annual International Solid Freeform Fabrication Symposium An Additive Manufacturing Conference OPTIMIZATION OF INERT GAS FLOW INSIDE LASER POWDER
More informationAIR FLOW DISTORTION OVER MERCHANT SHIPS.
AIR FLOW DISTORTION OVER MERCHANT SHIPS. M. J. Yelland, B. I. Moat and P. K. Taylor April 2001 Extended Abstract Anemometers on voluntary observing ships (VOS) are usually sited above the bridge in a region
More informationForest Winds in Complex Terrain
Forest Winds in Complex Terrain Ilda Albuquerque 1 Contents Project Description Motivation Forest Complex Terrain Forested Complex Terrain 2 Project Description WAUDIT (Wind Resource Assessment Audit and
More informationAnalysis on Turbulent Flows using Large-eddy Simulation on the Seaside Complex Terrain
Analysis on Turbulent Flows using Large-eddy Simulation on the Seaside Complex Terrain Takeshi Kamio, Makoto Iida, Chuichi Arakawa The University of Tokyo, Japan Outline Backgrounds and Purposes Complex
More informationSuper-parameterization of boundary layer roll vortices in tropical cyclone models
DISTRIBUTION STATEMENT A. Approved for public release; distribution is unlimited. Super-parameterization of boundary layer roll vortices in tropical cyclone models PI Isaac Ginis Graduate School of Oceanography
More informationPRESSURE DISTRIBUTION OF SMALL WIND TURBINE BLADE WITH WINGLETS ON ROTATING CONDITION USING WIND TUNNEL
International Journal of Mechanical and Production Engineering Research and Development (IJMPERD ) ISSN 2249-6890 Vol.2, Issue 2 June 2012 1-10 TJPRC Pvt. Ltd., PRESSURE DISTRIBUTION OF SMALL WIND TURBINE
More informationSpecial edition paper
Development of Train Nose Shape for Reducing Micro-pressure Waves Takeshi Kurita*, Yoichi Okumura* and Tsuyoshi Ichigi** To ensure that the micro-pressure waves generated during high speed running are
More informationSCIENCE & TECHNOLOGY
Pertanika J. Sci. & Technol. 25 (S): 227-238 (2017) SCIENCE & TECHNOLOGY Journal homepage: http://www.pertanika.upm.edu.my/ CFD Analysis on Indoor Temperature and Velocity: Effects of Incident Wind Angle
More informationEffect of Inlet Clearance Gap on the Performance of an Industrial Centrifugal Blower with Parallel Wall Volute
International Journal of Fluid Machinery and Systems DOI: http://dx.doi.org/10.5293/ijfms.2013.6.3.113 Vol. 6, No. 3, July-September 2013 ISSN (Online): 1882-9554 Original Paper (Invited) Effect of Inlet
More informationAnalysis of Pressure Rise During Internal Arc Faults in Switchgear
Analysis of Pressure Rise During Internal Arc Faults in Switchgear ASANUMA, Gaku ONCHI, Toshiyuki TOYAMA, Kentaro ABSTRACT Switchgear include devices that play an important role in operations such as electric
More informationA Study on the Effects of Wind on the Drift Loss of a Cooling Tower
A Study on the Effects of Wind on the Drift Loss of a Cooling Tower Wanchai Asvapoositkul 1* 1 Department of Mechanical Engineering, Faculty of Engineering, King Mongkut s University of Technology Thonburi
More informationModelling the Output of a Flat-Roof Mounted Wind Turbine with an Edge Mounted Lip
Modelling the Output of a Flat-Roof Mounted Wind Turbine with an Edge Mounted Lip S. J. Wylie 1, S. J. Watson 1, D. G. Infield 2 1 Centre for Renewable Energy Systems Technology, Department of Electronic
More informationStudy of Passing Ship Effects along a Bank by Delft3D-FLOW and XBeach1
Study of Passing Ship Effects along a Bank by Delft3D-FLOW and XBeach1 Minggui Zhou 1, Dano Roelvink 2,4, Henk Verheij 3,4 and Han Ligteringen 2,3 1 School of Naval Architecture, Ocean and Civil Engineering,
More informationKazuhiko TOSHIMITSU 1, Hironori KIKUGAWA 2, Kohei SATO 3 and Takuya SATO 4. Introduction. Experimental Apparatus
Proceedings of 4th Asian Joint Workshop on Thermophysics and Fluid Science Oct. 14~17, 2012, Busan, Korea Experimental Investigation of Performance of the Wind Turbine with the Flanged-diffuser Shroud
More informationControl of surge and pitch motions of a rectangular floating body using internal sloshing phenomena. Minho Ha and *Cheolung Cheong 1)
Control of surge and pitch motions of a rectangular floating body using internal sloshing phenomena Minho Ha and *Cheolung Cheong 1) School of Mechanical Engineering, PNU, Busan 609-735, Korea 1) ccheong@pusan.ac.kr
More information